Between the MTB stuff in the \\CNC_MEM\SYSTEM\ , \\CNC_MEM\USER\, and the \\CNC_MEM\USER\LIBRARY folders.... MTB stuff, tool measurement, spindle probing, user MACRO programs, etc... should take up less than 500kb, leaving at least 7,500kb free space.

My personal opinion is ALL part programs should reside and run from the DATA_SV. This provides one with the possibility of network backups which on CNC_MEM isn't possible... at least not the same way.

HTH

38 minutes ago, TFarrell9 said:

...I'm encountering a problem after indexing the RAH. G05.1 Q0 is commanded at tool end, before the RAH indexes. However, when it gets to G05.1 Q1 again (after RAH index, same tool), I get Alarm 5111 IMPROPER MODAL G-CODE (G05.1 Q1). I hit Reset, start the program from the G510 line and everything goes on as it should.

G05.1 is VERY picky about what is modal in activation/deactivation.

If I were a betting man, something is activated in your G510 MACRO that needs to be canceled. If you don't have access to the MACRO, cancel EVERYTHING between operations. 

G00G17G40G80G90G94G98
G49G53P1Z0.0S11460M03
N30001(Contour Back Edge for Inspection Surface - 3:00 Face)
G05.1Q1
G00G90G54...
G43Z4.0H#517
...
G40Y2.5625
G00Z4.0
G05.1Q0
G00G49G90G53P1Z0.0

I would try activating the G510 after the G54 or after the G43, the deactivating  either  before/after the G05.1Q0 or after the G49.  That's where I'd start.

Be careful with G49. If parameters are not set correctly, you will get a Z- move the equivalent to the length of your positive tool length offset.

HTH

2 hours ago, SuperHoneyBadger said:

Also, @cncappsjames, while I have your ear...

I'm seeing stuttering and jerky motion during code-dense dynamic paths with G131 on my 660 when the programs are in the data server, vs main memory. Is this expected behaviour? The programs are pushing 300kb, and it feels like it gets worse the bigger the files are. Any insight would be appreciated!

You've run the same program, the same way on both CNC_MEM and DATA_SV?

300kb is nothing. I routinely run programs 3-4x that without the stuttering you are describing.

A note on DATA_SV management, I have seen a performance degradation when there are "a lot" of programs in the root DATA_SV. I always recommend customers to use folders and sub-folders. I don't have a definitive number of programs when the performance degredation starts unfortunately. It was just something I noticed accidentally. So I typically reccommend \\DATA_SV\CUSTOMER_NAME\PART_NUMBER\REV\ for a structure. This keeps things clean. organized and running smoothly... in my experience anyway.

5 minutes ago, SuperHoneyBadger said:

So, start coolant, start spindle, unlock rotary could all activate on a single line and would happen simultaneously?

I'll have to try it and get out the stopwatch

M203 M08 M132 can all be in the same line.

This would ONLY apply to 5-Axis Matsuura machines WITH touch panels AND built after 12/2021.

Ok, you're probably up to date on code formatting. Touch panel machines built after 12/21 can do multiple non overlapping m-codes on the same line, and have a few other pretty awesome functions. Depending on a number of programming paths, plane changes and canned cycles, I've seen 20% reduction in cycle time old vs. new. Sometimes more.

Matsuura does have a software update available for the 5-Axis machines built prior to that date. It's not free - I have absolutely no idea of the cost so don;t ask. I don;t even know the ballpark number unfortunately. I do know FANUC and the Matsuura factory needs to get involved which is why it costs. Me, I'm trained to do the Matsuura side software update (I believe I'm the only non-factory guy in the US that can do it) but FANUC needs to come out and update the CNC System Series and Edition software. See below for the machine's requirements top be eligible for an update.

In order for any 5-Axis Matsuura to receive this update it must have the following;

1. FANUC-31i-B5 Control

2. Panel-i or iHMI interface

3. FANUC System Software Series G423 or greater

4. FANUC System Software Edition 49.0 or greater

5. Software from Matsuura

6. Software installation from Matsuura (or a factory trained engineer).

              If items 3 and 4 are not true, the machine dealer must issue a request to Matsuura USA, Matsuura USA must issue the request to FANUC to update the System Software to the minimum required for the update and Matsuura USA must issue the software request to Matsuura Japan. There would be a charge for the FANUC trip, how much depends on location; the 3 tiers for travel are less Than 4 hours, 4-8 hours, and 8-12 hours. Not sure what Matsuura is charging for the updates. Probably depends on proximity to Minneapolis, Minnesota.

2 hours ago, Kyle F said:

I just pulled some super slick lookin' 15-5 stainless rocket engine parts off my UMC ! 

Now I'll just be able to do them in half the time on the mx-330 lol

Probably not too far off.

This is my latest 3+2 format (for 5-AXis machines built after 12/2021 or machines with the Cycle Time Reduction spec software upgrade);

#996=0.75(CAM TOOL DIA.)
N2T2M06(0.75 in squareend assembly)
G00G17G40G80G90G94G98M132
G49G53P1Z0.0T1M08
N30001S11460M203(OPERATION COMMENT HERE)
G05.1Q1
G00G90G54B-90.0C-180.0
G54.4 P2
G68.2 X0.0 Y0.0 Z0.0 I-90.0 J-90.0 K-90.0
G53.1
X-0.053Y2.0834
G00G43Z0.702H#517S11460M03
G05.1Q3X0Y0Z0
G00Z-0.2979
G01G41X0.2652Y1.7652D#517F120.0
...
G01G40X0.0601Y2.1824
G00Z0.702
G05.1Q0
G00G49G90G53P1Z0.0M229M205
G69
G54.4 P0
G130

(INSERT TOOL BREAKAGE CYCLE HERE IF DESIRED)
M05
M09
G00G17G40G49G80G90G94G98
M01

5-Axis w/3DCC;

( *)
#996=0.0313(CAM TOOL DIA.)
N5T5M06(Tapered tool assembly)
G00G17G40G80G90G94G98
G49G53P1Z0.0T6
N50020S12000M203M132(Flow ISO-TC39SC2-N2185 Feature - Side 1)
G05.1Q1
G131F1
G00G90G54B-29.755C122.76
G54.4 P2
G68.2 X0.0 Y0.0 Z0.0 I212.76 J-29.755 K-90.0
G53.1
X-0.4636Y0.5398
G69
G43.8Z1.2495H#517D#517S12000M03
X0.0994Y-1.152Z0.8547,L2I0.5411164J-0.840937K0.004251
X-0.102Y-0.839Z0.2035,L2I0.5411164J-0.840937K0.004251
X-0.1423Y-0.7764Z0.0733,L2I0.5411164J-0.840937K0.004251
G01X-0.1611Y-0.7472Z0.0125F9.0,L2I0.5411164J-0.840937K0.004251

...

X0.1438Y-0.1655B-22.642C-293.154,L2I-0.3899529J-0.9118848K0.1280734
G00X0.1048Y-0.2567Z-0.1284,L2I-0.3899529J-0.9118848K0.1280734
G05.1Q0
G00G90G49
G49G53P1Z0.0
G54.4 P0
G130
M05
G00G17G40G49G80G90G94G98M229
M01

5-Axis w/CC

( *)
#996=0.1875(CAM TOOL DIA.)
N4T4M06(Tapered tool assembly)
G00G17G40G80G90G94G98
G49G53P1Z0.0T5
N50018S12000M203M132(5-Axis Swarf Side Rough +.005 on wall)
G05.1Q1
G00G90G54B-1.016C-5.894
G54.4 P2
G68.2 X0.0 Y0.0 Z0.0 I84.106 J-1.016 K-90.0
G53.1
X0.039Y0.1389
G69
G43.4L1P3Z0.8589H#517S12000M03
G131F1
X0.0379Y0.1358Z0.8602
X0.0511Y0.1344Z0.1103
X0.0537Y0.1341Z-0.0396
G01G41.2X0.0549Y0.134Z-0.1076D#517F90.0

...

G40X0.0476Y0.1333Z-0.1088
G00X0.0356Y0.1512Z0.859
G05.1Q0
G00G90G49
G49G53P1Z0.0
G54.4 P0
G130
M05
G00G17G40G49G80G90G94G98M229
M01

23 minutes ago, AHarrison1 said:

I hope you didn't have to go through the whole process of having to identify as a tool changer

 

Could be worse... could have had to identify as a Gender Changer.

What's the manufacture date of your machine @SuperHoneyBadger?

On 1/10/2024 at 3:26 PM, Kyle F said:

...

My UMC-500 has taught me many ways to program around it's flaws haha. I can personally get what I think is decent results considering the machine's inherent flaws....

We have a lot of customers that do very well with their Haas machines. They understand what the machine is and what it isn't and work around it.

On 8/20/2022 at 2:39 AM, DavidB said:

...I will never buy another HAAS. The next 5-axis I bought was DMG MORI DMU 50 and it's amazing.

You bought a completely different class of machine, it SHOULD have been an amazing difference. Yours is not a typical experience. If you would have bought a Matsuura you would have never even looked at a Mori so there's that.

The opinion probably came from the early days (pre- [b]i[/b] Series Controls) when because the function was called "look ahead" and there were not any levels attached to it. It was either on or off. So, it was thought there was no benefit to a "look ahead" for positioning type tool-paths because it was just going from A to B and it wasn't performing any contouring type motion. But with modes and levels, you gain some functions.

On 2/26/2024 at 7:11 AM, SuperHoneyBadger said:

So drilling and reaming can leverage hi-speed? I have all my posts (31i - VX660's) configured to not output G131's on canned drill cycles, I thought it was a no-no?

Yes you can. It is kind of an Urban Legend that you can't or shouldn't. I have been doing it for years. On a Matsuura we don't have any trouble rigid tapping with the mode(s) active. For other manufacturers I would consult their Applications Engineers for guidance.

On 1/24/2006 at 11:35 PM, Lars Christensen said:

AND if you do use G5 make sure that you turn it of before any drill cycle!!!!

Updated for 30i Series Controls on a Matsuura 5-Axis Machine w/ FANUC 31i-B5 Control (date of test 12/1/2023)
Test - mix of  G81, G83, and G84 cycles

(3:24 - W/ NO HIGH SPEED MODES)
(3:11 - W/ G05.1Q1, G05.1Q3, AND G131 D1)
(3:07 - W/ ONLY G05.1Q1)
(3:06 - W/ G05.1Q1 AND G131 D1)
(3:06 - W/ ONLY G131 D1)

G131D1 is specific to Matsuura machines and assigns acc/dec values to the appropriate parameters. The D is used for positioning type cutting as opposed to contouring type cutting. So we can definitively say that it IS indeed faster to run your canned cycles with at least FANUC's G05.1Q1 mode active.

Hopefully we can finally put that myth to bed.

Is there a slot inside the control cabinet by chance?

When in doubt, blame the new guy. Works every time... unless your shop practices "Extreme Ownership", then it's the leader's fault for not making sure everyone was adequately trained.

Bored machinists on night shift and magnesium. Sounds terrible. What's the address? Asking for a friend. 

Tantalum... yum.

I had to sandwich that stuff to keep it from flaking. What a PITA it is. And HEAVY AF! 

On 2/13/2024 at 8:43 AM, ogu79 said:

Peck drill cycle time is reasonable in the machine simulation but it is significantly off...

That's because the simulation cannot take into account acc/dec which is different for every machine and different axes.

Run a sample canned cycle in the machine(s) in question, figure out what the factor is and add that in to the cycle time.

I've only ever run it dry or with cutting oil and NEVER unattended.

If at all possible I highly suggest cutting oil as opposed to coolant. Cutting it with water-based coolant creates hydrogen gas which can be explosive in enclosed areas.

Class D Fire extinguisher and sand on hand FTW

JM2CFWIW

Try these @Aaron Eberhard 

https://www.amazon.com/Onefavor-CompactFlash-Cards-Industrial-Memory/dp/B018WZ4UYQ/ref=mp_s_a_1_3?crid=31ODRAT46Y5QL&keywords=64mb%2BCF%2BCard&qid=1707744637&sprefix=64mb%2Bcf%2Bcard%2Caps%2C177&sr=8-3&th=1&psc=1 

https://www.amazon.com/Onefavor-CompactFlash-Cards-Industrial-Memory/dp/B018WZOEJC/ref=mp_s_a_1_3?crid=31ODRAT46Y5QL&keywords=64mb+CF+Card&qid=1707744637&sprefix=64mb+cf+card%2Caps%2C177&sr=8-3 

5 hours ago, Aaron Eberhard said:

Ooh, I'll have to try that.  I couldn't get the card to read on my 98 Fanuc Robodrill. ...

You're going to need a card smaller than 128MB IIRC for pre 2000 machines. Honestly I'd go with a 64MB just to be safe. 

23 hours ago, Aaron Eberhard said:

Hmmm... an MX-420 would probably look great in my garage!

That's a great multi-pallet starter... no question. Full Featured, 10 pallets, 90 tools, not a huge footprint either.

1 minute ago, Aaron Eberhard said:

I would love to hang out with you for a day!  What machine do I need to buy?

Get a Matsuura and we can DEFINITELY work something out.

On a case by case basis, I will travel anywhere.

On 2/1/2024 at 8:24 AM, Aaron Eberhard said:

Another overlooked thing is to schedule some time with your machine tool's AEs.  

As a Machine Tool Dealer AE, I cannot stress this enough. SO many people will fumble their way through, find a way that works-ish, then get married to that. Then WHEN issues crop up they may find themselves painted in a corner. I've last count the number of individuals I've had to untrain and retrain. Personally I don't mind it, it's part of the job, but let's face it, sometimes there's some ego involved and that can make for a difficult training experience if one is not open to change.

So, before you go down the 5-Axis MACHINE side blind, call your builder/dealer and schedule some training. It'll be worth the effort.

The machining envelopes I work in 90+% of the time are within a 1m x 1m Envelope... so, typically, I will "fast" position about 5,000mm/min. That seems to keep the sheet metal intact. and it's not terribly slow. The reason you DO NOT want Acc/Dec active while probing is because you need the machine in essentially exact stop check mode to get the most accurate positioning measurements.

If I were working on large gantry equipment, I'd probably have graduated feeds so say start out at F2000mm/min for 25mm, F5000mm/min for 25mm, then get up to F15000mm/min, then back down the same when I come close to my final measurement position.

JM2CFWIW