4th axis

[TheePres]

Hello All.

Does anyone use the MPMASTER post on a HASS 4th axis rotary, right out of the box, without any tweaking??

[crazy^millman]

Yeah right here: 100 free man hours of Tweaked post for 4 axis HAAS

 

HTH

[TheePres]

Thank You Sir, im sure has switches on how rotary table is orientated?

[crazy^millman]

Yes it does here is what my MPMASTER is set up like for our HAAS machines.

 

code:

---

# Typical Vertical

srotary "A" #Rotary axis prefix

vmc : 1 #0 = Horizontal Machine, 1 = Vertical Mill

rot_on_x : 1 #Default Rotary Axis Orientation, See ques. 164.

#0 = Off, 1 = About X, 2 = About Y, 3 = About Z

# Typical Horizontal

#srotary "B" #Rotary axis prefix

#vmc : 0 #0 = Horizontal Machine, 1 = Vertical Mill

#rot_on_x : 2 #Default Rotary Axis Orientation, See ques. 164.

# #0 = Off, 1 = About X, 2 = About Y, 3 = About Z

rot_ccw_pos : 0 #Axis signed dir, 0 = CW positive, 1 = CCW positive

ret_on_indx : 0 #Machine home retract on rotary index moves, (0 = no, 1 = yes)

index : 0 #Use index positioning, 0 = Full Rotary, 1 = Index only

ctable : 5 #Degrees for each index step with indexing spindle

one_rev : 1 #Limit rotary indexing between 0 and 360? (0 = No, 1 = Yes)

lock_codes : 0 #Use rotary axis unlock/lock M-Codes? (0 = No, 1 = Yes)

use_frinv : 1 #Use Inverse Time Feedrates in 4 Axis, (0 = no, 1 = yes)

rot_feed : 1 #Use calculated rotary feed values, (0 = no, 1 = yes)

maxfrdeg : 2000 #Limit for feed in deg/min

maxfrinv : 999.99#Limit for feed inverse time

frc_cinit : 1 #Force C axis reset at toolchange

ctol : 225 #Tolerance in deg. before rev flag changes

ixtol : .01 #Tolerance in deg. for index error

frdegstp : 10 #Step limit for rotary feed in deg/min

---

Then I use the G154 P for fixture offset and that si doen by changing the PWCS to this:

code:

---

pwcs            #G154+ coordinate setting at toolchange

if wcstype = two | wcstype > three,

[

sav_frc_wcs = force_wcs

if sub_level, force_wcs = zero

if sav_mi9 = 1, workofs = sav_workofs

if workofs < 0, workofs = 0

if workofs <> prv_workofs | (force_wcs & toolchng),

[

p_wcs = workofs

if p_wcs = 0, # This Will Output P1 is Work offset is 0

[

p_wcs = 1

]

"G154", *p_wcs

]

force_wcs = sav_frc_wcs

!workofs

]

---

Then I have also added this to my post Thanks to Rekd:

code:

---

pcorner_round	#corner rounding ()

if mi5 = 1 & mr5 > 0 & flg_mi5 = 0,

[

sav_mr5 = mr5,

pbld, n, "G187", *sav_mr5, e

flg_mi5 = 1

]

if mi5 = 1 & mr5 = 0,

[

"( WARNING!! CORNER ROUNDING CONTROL HAS )", e

"( BEEN ENABLED WITHOUT A VALUE SET! USE )", e

"( MISC VALUES-MISC REALS TO SET A VALUE )", e

"( CORNER ROUNDING CONTROL IS DISABLED )", e

]

if mi5 = 0 & flg_mi5 = 1,

[

n, "G187", e

flg_mi5 = 0

]

---

I also have manunally index:

code:

---

pindexman   #Manunal Indexing ()

if mi4 = 1,

[

sav_mr4 = mr4,

pbld, n, *sav_mr4, e

]

---

And then I have automatic program numbering if I dont have it done.

code:

---

pheader         #Call before start of file                         

if met_tool = one, #Metric constants and variable adjustments

[

ltol = ltol_m

vtol = vtol_m

maxfeedpm = maxfeedpm_m

]

result = nwadrs(srotary, cabs)

result = nwadrs(srotary, cinc)

result = nwadrs(srotary, indx_out)

 

"%", e

spaces=0

if progno = 0,

[

progno = 10000

]

if mi6 = 0,

[

---

None of mine helping you get your post the way you want but you know we dont give away fully tweaked posts. Have a good night and hope that help. All information is given to help not hinder and use it at your own caution.

[cadcam]

Theepress, if you need any help with the post for Haas you have my cell.

[TheePres]

Thanks Mill-Man for that info.

Cad-Cam, will be calling you soon.

[Gorn]

Maybe I am missing something but I just use the MPHAAS.PST that ships with Ver 9.1 for my true 4th axis stuff. Works great for me. No tweeking at all.

[crazy^millman]

Gorn I like the MpMaster because it has alot more information to give to the operators than the others. I have also added other things to my post like a Mi6 control to strip all nc commnets out of the post for ethernet or right of the the hard drive running or programs on our HASS mills. I also thanks to Rekd have canned cycles in our post using the Drilling cycles. I think it really boils down to each person and what they like but I think that is a good post just some resaons why I like the MpMaster post and going from there.

 

HTH

[Lathe-Mill]

I use the haas post from cd, no changes, works fine for me.no changes at all.