4th axis A output

[mayday]

Im using the latest mpmaster and not getting A index output to post on named views for positions. it only outputs 0,90,180,270 system views.

I have named views at 60,120, and 240

 

what am i missing?

[Jack Neelands™]

using mx?

or version 9?

[mayday]

X mr2.

[Don S at Barefoot CNC South]

Hey Wes how are ya?

What machine is this post for?

[mayday]

its a Haas Don

everything looks right verify shows it and backplot shows it. I tried the default posts and the mpmaster. they all do the same thing. I set up named views just as I did in V9

[Don S at Barefoot CNC South]

Wes can you send me your part file so I can look at it?

[Jack Neelands™]

sorry i cant help wWes ...im still waiting for my employer to send me off for X training...even though it sits here on my puter gaining dust as we speak...been 8 months now...maybe i will catch the next version...like XI

[mayday]

on its way Don

[mayday]

So much for WCS systems

figured out what was wrong. I initally had the part in a vice opp. when I created a WCS for the index opp MC is lost in space. I saved the file and reoriented the part for the indexer and now it outputs the A moves

 

Come on CNC

[Don S at Barefoot CNC South]

lol Wes I just found that out also

[mayday]

WTF ? I thought this was all fixed now. wasnt that the big tado for X. you cant have a vice opp and an index opp all in the same file I guess

that blows

I have a lot of files that require an initial first opp and secondary 4 or 5 axis opp. cant mix n match

[Jaz]

I mix & match all the time. 3 ops, 3 machines, no big deal. I do it all with WCS. Things to check: do all the ops reference correct WCS and T/C planes? Is the machine definition right? Are your T/C planes oriented correctly with respect to the WCS you want to use?

[Colin Gilchrist]

Hey Guys,

 

You can also load multiple Machine groups and have different settings for each Machine group. So potentially you could write a program to rough out a part on one machine, write a finish program for another mill, and even write a lathe toolpath to do a big bore if necessary, all in one part file. Also, when doing rotary axis programming, use WCS instead of T/C Plane. You will like the results much better. Remember that you can import Views into the View manager as well. One of the things I do for A axis programming is create a "seed" model with The common planes I want: 0, 45, 90, 135, 180, 225, 270, 315, and 360 degrees. All created by rotating my WCS (top initially) by 45 degrees about the X axis. Then I save the model as A Axis Views. When I want to machine a new 4th Axis job I open the view manager, right click and select import. I browse to the location of my seed model and import the view. And just like that I have 8 new planes, rotated by 45 degree increments about the A axis. They all come in with their names as well. If you want to program a vise job with no A axis code output, then load a machine group with a properly configured machine ( i.e. copy your 4 axis machine definition, remove the rotary A axis and the fixture/holder component, go into Axis Combinations and update. Now save the new machine def. with a new name).

 

Hope that helps,

 

Colin

[Rick Henrickson The Boeing Co.]

I have never had problems with it using MR2 if you have your WCS set and the T/C planes our in its range of rotation and proper orientation to the axis should not be a problem.

[Don S at Barefoot CNC South]

Wes

I tried to send you an email with your file that I worked on but it says your mailbox is full.

[mayday]

quote:

---

but it says your mailbox is full.

---

i know, i know

im so dam popular

[Don S at Barefoot CNC South]

Wes you have more mail has to do with the lathe