Verify Slot Mill cutter

[DavidB]

Tool is 125mm Dia x 3wide R1.5

In verify it looks like this?

Qaulity is highest.

I use this to rough slot then finish with endmills.The slot cutter acyually Verify as a gouge because when the slot drills go down the floor does not kleen up.

The slot mill is programmed to leave stock.

The BLUE cutter should look round on the OD not like a point.

 

 

 

Finish cutter done gouge in Verify from slot cutter

[Allan]

What is your tool tolerane set to?

 

From the help:

 

Sets tolerance for tool simulation. This parameter is only used for tool simulation when highest quality display control setting is selected in Verify controls dialog box.

 

The default is .008"

[gcode]

Try changing the tool tolerance from its default setting of .008 to .001.

[DavidB]

Mine is set to 0.008mm the slot cutter is programmed to leave .2mm stock.

Thats alot greater than the 0.008mm Tool Tolerance

[gcode]

try changing the R1.5 to R1.48

[DavidB]

gcode,

The cutter is 125mm Dia x 3wide with a 1.5mm Rad.

If it was just the graphics I'd live with it but it Verifys differant than what it actually cuts.

 

This slot cutter has .2 stock programmed and as you can see when the Bull cutter does the final size the Verify from the slot mill does not clean up.

 

Vericut is fine.

 

Most poeple rely on Verify for checking and Mastercams Verify should be better than what it is. This sort of thing should not happen.

 

Here is another Verify thread.

Lathe Verify

 

I got an answer back from CNC about Lath Y-axis in Verify. Problem has been logged as a bug.

[Allan]

I just made that tool in a metric config, the .008 setting seems to be in inches no mater what your config is set to. Cutter profile looks much better / not perfect when set to the smallest setting of .0001. You may get better results with the tool shape tied to a .mcx file.

 

Allan

[gcode]

You also get better results if you set the corner radius a tiny bit smaller than R1.5.

If you have a 3MM wide cutter and tell Mastercam

its got 1.5R corners, it causes problems.

If you define the radius is slightly smaller

(1.48 or 1.49, you will get better results

and the .001 flat on the cutter is meaningless