posting an M00 before multiple engravings?

[strikur]

How do I setup mastercam to post an M00 code before each engraving operation? Using X2

[crazy^millman]

Just use manual entry and then you can put in your man comments Set it up as code if you do so. If the post does does not support this we can show you how to fix it.

 

BTW welcome to the forum.

 

Also what version of Mastercam are you using??

[Guest John Paris @ Services 4 Automati]

quote:

---

Using X2

---

 

Welcome to the Forum

 

strikur

 

[Columbo™]

quote:

---

Welcome to the Forum strikur

---

[Tim Johnson]

You can go into the Toolpath Parameters page, hit the Canned text button, move the M00 option to the right side with the "before" choice turned on.

[strikur]

Can you be more specific as to how to setup the canned text, made one attempt and it put an m00 at every z retract move. Im using x2 version of mastercam

[Midwest]

quote:

---

M00 code before each engraving operation?

---

Check the "Force tool change" on each operation you want.

 

This gives you a M01

 

HTH

 

 

[Tim Johnson]

Sorry, the text said "before" and I took that to be before the operation, not before every fricken depth of cut.

[Tim Johnson]

Ok, I set up canned text 11 for an M00 call. First I added the text in the canned text area. (bottom of the post)

code:

---

[canned text]

1. "Stop - M00"

2. "Op Stop - M01"

3. "Bld on"

4. "Bld off"

5. ""

6. ""

7. ""

8. ""

9. ""

10. ""

11. "M00 (LUBRICATE HOLES FOR TAPPING)" #<<<<<<<<<< I added this line

[CTRL_TEXT_END]

---

Then I added the callout in ptlchg$

code:

---

ptlchg$          #Tool change

pcuttype

toolchng = one

toolcount = toolcount + 1

if toolcountn <= tooltotal, nexttool = rbuf(4,toolcountn)

else, nexttool = first_tool$

if wcstype = one, #Work coordinate system

[

pfbld, n$, "G28", "X0.", "Y0.", e$

pfbld, n$, "G92", *xh$, *yh$, *zh$, e$

]

if prvtool = 59,

[

"M00", "(CLOSE DOOR)", e$

"#151=#0", e$

*sm01, e$

p_probe_v526

]

else,

[

"#151=#0", e$

if cantext$ = 11, *sm00, "(LUBRICATE HOLES FOR TAPPING)", e$ #<<<<<<<added this

else,*sm01, e$ #<<<<<<<<<<< updated this

]

" ", e$

ptlchg_com

---

I had to put a condition on pcan in my tool change postblock;

 

code:

---

      if cantext$ <= 10, pcan

---

This is what the post outputed;

code:

---

N6 G91 G30 X0 Y0 Z0

#151=1

IF[#[10000+44]GT13.75]GOTO99001

M06 T44 ( NO.36 DRILL)

T41

#170=4060

#172=5202

#199=0

M[#926]

M[#925]

M[#927]

M98P5036

M09

M56

M58

M05

G91 G30 X0 Y0 Z0

#151=#0

M00 (LUBRICATE HOLES FOR TAPPING)

 

N7 G91 G30 X0 Y0 Z0

#151=1

IF[#[10000+41]GT13.75]GOTO99001

M06 T41 ( 8-32 PULLEY PLUG TAP)

T43

#170=4070

#172=5204

#199=0

M98P5036

M05

G91 G30 X0 Y0 Z0

#151=#0

M01

---

You will need to replace your machine def in your toolpath manager to see the text in the canned text section.

 

There would be a lot more work if you want to use the first ten cycles but the bottom 90 seem pretty easy.

[Charlie Pierson]

If you want the M01 at every tool change then you could hard-code it in ptlchg$

if the same tool is doing different enough cuts then try hard-coding it in ptlchg0$

 

if you need a different trigger for the M01 you're gonna have to find the variable that you want and trigger the M01 output on that variable.

 

I'm at home now so's I am w/o my resources

 

cp

[Guest]

BTW, maybe I am overlooking something but MPMaster has an mi variable(mi9) set to output an M00 or M01 before each operation.

[Charlie Pierson]

sorry, I meant 'M00'