MP master toolchange code post help

[Roger D]

I,m using an older Yang mill with a Fanuc Om control.I would like the code to put the M6 on the line after the tool call,I would also like to change the dia wear offset from D to H,also how do you stop the P in dwell outputting a decimal point?

Thanks for any help I'm a post novice so your not dealing with the sharpest knife in the drawer.

 

Roger

[Justin Beebe at Folsom Tool]

Roger,

 

What version of mastercam? I don't have the answers but people may need this info to help you.

[bigjohn]

What post are you using? The more info you give the better answer you'll get.

[Dave Ball]

Look for this line in your post and change the D to H.

 

code:

---

fmt  D  4   tloffno$    #Diameter offset number 

---

If your using Mpmaster look for this line in ptlchg_com

 

code:

---

if tseqno = 2, n$ = t$

pbld, *n$, *t$, "M06", ptoolcomm, e$

]

else, pbld, n$, *t$, "M06", ptoolcomm, e$

]

---

and change it to look like this

 

code:

---

if tseqno = 2, n$ = t$

pbld, *n$, *t$, e$

pbld, "M06", ptoolcomm, e$

]

else, pbld, n$, *t$, e$

pbld, "M06", ptoolcomm, e$

]

---

but is you have an older X post look for the ptlchg$ block and change this

code:

---

pbld, n$, *t$, sm06, ptoolcomment, e$ 

---

to this

 

code:

---

pbld, n$, *t$, e$

pbld, n$, sm06, ptoolcomment, e$

---

[Roger D]

Sorry,I'm using X2 MR1 and the latest mp master mill post.Thanks ShefferCNC I will try that at work tomorrow.

Thanks

Roger

[Roger D]

ShefferCNC that worked perfectly,thanks for your help.

Roger

[Colin Gilchrist]

Hi Roger,

 

Your Dwell statements are setup to use Format Statement 11, which is 'absolute 3 place decimal'.

 

How is your machine setup with regards to dwell? Most machines can read dwell increments down to one thousandth of a second (.001)...

 

Why do you want to dwell for an entire second at the bottom of the hole? Or more importantly, why does the decimal point bother you?

 

What do you want the code output to look like if you only want to dwell for a quarter of a second? Right now you would enter .25 and be done with it. That would give you a P.25 value.

 

Does your machine use different dwell notations?