High speed machining

[Candyman]

Hi all, whats the best way to have mastercam add the following lines to my program:

 

G05P10000 to enable the high speed machining function at a position after my G43 H1 Z10. ect line

and then

G05 P0 to cancel the high speed machining function at the end of my program..

 

 

i dont want this to appear everytime i create a program .. i want to be able to select when i want it..

thanks paul

[gcode]

check out the mpmaster post available for free from this website.

 

it has high speed output options available on the misc page

[Tony35]

if you are using a MPMaster post

in the misc values, MR1=3 will give you this output

[Jasond0530]

Add this to post after g43 line!

 

" if (mi6$ = 1),

[

pbld, n$, "G8 P1", e$

hssw = 1

]

if (mi6$ = 2),

[

pbld, n$, "G5.1 Q1", e$

hssw = 2

]

"

And this at end of tool path

 

" if (hssw = 1),

[

pbld, n$, "G8 P0 ", scoolant, e$

hssw = 0

]

if (hssw = 2),

[

pbld, n$, "G5.1 Q0 ", scoolant, e$

hssw = 0

]

"

 

you will also need to add this to the General Output settings part

 

"hssw : 0"

 

also change the descriptor for Mi6 to " 6. "High Speed [ 1 = G8 P1, 2 = G5.1 Q1 ]"

 

hope this helps