Integrex E420

[Dtm]

I have this part that is hot. Friday when I went to run it the machine didn't recognize the plane change and was lost. I figured out that problem. The post was not putting a G68 which I turned on in the mis. values. I made the G43 a G43.4 and now the machine accounts for the plane rotation. When I run the program everything looks good until I hit the G91 incremental mode. The postion page on the machine shows all axis moving, but the machine doesn't appear to be moving. I know this is a post problem but In house solutions is closed and my machine is setting. Could someone post the last two ops of the file? Any suggestions of a work around? I tried a 5-axis curve tool path and had no luck I put the file on the ftp site in the x5 files called E420. For some reason I saying my jpeg of the program is to large to upload ( 215 KB ) not sure about that.

[Dtm]

I just put the Jpeg of the program in the ftp with the file. I'm not sure how many are using the multi-axis E420 if any, but I thought I would take a stab in the dark.

[mayday]

What are you trying to do, follow the helix around the part? you only need G43.4 for 5 axis tooltip comp. your paths are only 2d contour.And yes, any 2d work not using the right toolplane needs the G68 rotation

[Dtm]

What are you trying to do, follow the helix around the part? you only need G43.4 for 5 axis tooltip comp. your paths are only 2d contour.And yes, any 2d work not using the right toolplane needs the G68 rotation

 

Yes I want to follow the helix around the part. The file I posted is what I want. It looks like the feed rate calculation in the G91 is incorrect.

[mayday]

Inverse time feed and G91 dont get along together. Put a G94 with the G91 line. and dont use G43.4 with that path.

[Dtm]

Inverse time feed and G91 dont get along together. Put a G94 with the G91 line. and dont use G43.4 with that path.

 

If I don't use G43.4 the machine doesn't know the B-axis rotated. So, should I make it G43 and manually add the G68 and then do as you say?

[crazy^millman]

I assume you are trying to mill this because it is a round thread with a certain start and end place in relation to something else on the part? You could use a 5 axis toolpath, but would just need to call ti correctly. You are trying a 3d toolpath not going ot work and neither is G68 IMHO. I think an Axis Sub or a 4 axis toolpath might be your better bet. The G68 could come into play at that point, but not really getting what you are trying to accomplish looking at it. Mind explaining it a little further?

[mayday]

sorry for droping out on you DTM, I have 6 Integrexes that keep me rather busy. 2 of them are E420H. I probably have the same post you do from In-house so I dont think it's a post problem. I agree with Ron, your better off using a 5X path on that. I do very little 2d work on our machine's and when I do I usually drive them with 5 axis paths. The machine just likes it that way

[MIL-TFP-41]

Forgive me if I am wrong.....didn't you change to Gibbs?

[Dtm]

Forgive me if I am wrong.....didn't you change to Gibbs?

 

I bought gibbs for contract work, but I still use mastercam at my day job.

[Dtm]

I assume you are trying to mill this because it is a round thread with a certain start and end place in relation to something else on the part? You could use a 5 axis toolpath, but would just need to call ti correctly. You are trying a 3d toolpath not going ot work and neither is G68 IMHO. I think an Axis Sub or a 4 axis toolpath might be your better bet. The G68 could come into play at that point, but not really getting what you are trying to accomplish looking at it. Mind explaining it a little further?

 

Yes this is a thread and has to start at certain spot. Just run the verify and you can see what I'm doing ( It takes a few minutes due to the thread ). Mazak confirmed this is a post issue. I couldn't get a five axis toolpath to work, but I didn't spend to much time due to all my other projects. The boss just wants the post fixed. I have a bit of time now so I will try to run a few more 5-axis tool paths.

[crazy^millman]

Send me a file and I will run it though my Intregex Post and let you see if the code if different.

[Dtm]

Send me a file and I will run it though my Intregex Post and let you see if the code if different.

 

It's on the ftp site, x5 folder called e420.

[Dtm]

Thanks for all your help guys. I finally got a 5-axis curve toolpath and just dry ran it and it looks good.