toolpath transform rotate

[Candyman]

Hi all,

is it possible for mastercam to output only the a 90, a180,a270 ect and not g55,g56,g57 on a toolpath transform rotate toolpath?

Thanks

[gcode]

yes.. and how you do it depends on the version and post you're using

 

you shou be able to select the radio button " Maintain source's operation"

 

and all the children should have the same workoffset as the parent... but it doesn't always work..

[MACHINING JIM]

I usually go into misc values in each of the ops I want to transform. I uncheck the box that says "automatically set to post values when posting" and change the "lock on first wcs" to on. This will lock the transform to G54.

Perhaps there is a better way but thats how I manage.

[gcode]

That's how I do it too, buts that option is only available in mpmaster posts.

 

If you're running 5 axis posts, there is a switch you can flip..

 

I'm not sure what the best way is with a regular Mastercam post

[left coast lefty]

I usually go into misc values in each of the ops I want to transform. I uncheck the box that says "automatically set to post values when posting" and change the "lock on first wcs" to on. This will lock the transform to G54.

Perhaps there is a better way but thats how I manage.

 

Where is the "lock on first wcs" button? Brain cramp.

[K2csq7]

It is in the Misc integers (#9 IIRC), but only if your using a MPmaster post...

[left coast lefty]

It is in the Misc integers (#9 IIRC), but only if your using a MPmaster post...

 

Thanks.

[Russh67]

What I've done for a rotary is to number all work offset to 0 in the view manager. I also arrange ops in order of rotation if possible to minimize tool change.

 

Forgive me I do not know how to put up a thumbnail so here is a sceen shot in a word doc.

 

How do you put up a screen shot via thumbnail.....or some thing

rotary.doc

[PeterM]

I do transform ops often, certainly weekly. Using a slightly modded hass post " Maintain source's operation" always works for me. I Set my first workshift. Pre X6 I used "assign new and set "Start" to what I wanted and "increment" to 0, but I can no longer set increment to 0 in X6. Still works for me.