5 AXIS HELP

[Dont]

I have 3 bolt circles each bolt circle on a angle. The 2 outer BC have 24 holes each and inner 16. each hole has a c-bore with a slot. Is there a easier way then creating 64 different planes?

Thanks for any help you can give.

[Jayson Kramer]

if it is a solid you can use the hole axis to create vectors for quick picking or use the Verisurf tool that has hole axis and it will work with surfaces.

to start.

[CJep]

create vectors for all the holes and use the drill multiaxis tpath,

when selecting your geom use points and lines,

you can control the depth of cut by using comp surfaces

[Guest MTB Technical Services]

Yes, use the FBM Toolpaths for the holes and slots.

It works GREAT.

 

What you have to do is a perfect application for it.

To drill and mill all those features individually would take WAY too long.

 

http://www.emastercam.com/board/topic/78614-mastercam-fbm/#entry939734

[kccadcam]

Normal drill and contour operations, program one hole/slot for each diameter.

Transform, Rotate toolpath about centerline of part.

 

Then you only have to create 3 different planes instead of 64.......

 

 

[Dont]

Normal drill and contour operations, program one hole/slot for each diameter.

Transform, Rotate toolpath about centerline of part.

 

Then you only have to create 3 different planes instead of 64.......

I tried that didn"t want to work.

[Joe788]

I tried that didn"t want to work.

 

It'll work. You just have to tinker around with the rotation plane settings.  I've done it on a bunch of parts and always forget how to get good output by the time I'm doing again.

[MrFish]

Normal drill and contour operations, program one hole/slot for each diameter.

Transform, Rotate toolpath about centerline of part.

 

Then you only have to create 3 different planes instead of 64.......

 

This is how I would do it too. What didn't work ?

[GoetzInd]

My vote would be to create a few planes and transform. Can you post a file?

 

Mike

[CJep]

It'll work. You just have to tinker around with the rotation plane settings.  I've done it on a bunch of parts and always forget how to get good output by the time I'm doing again.

 

If you're using custom planes for the rotary output then set the origin of the tilted plane to match the center of rotation

I usually set Mcam's origin as the center of rotation.

[Dont]

This is how I would do it too. What didn't work ?

I got transform to work had to set plane to TOP in transform parameter. Thanks for all the replys

[Dont]

Well it verify looks good but when I post it its giving me a different fixture offset for every hole. Any ideas? I keep switching stuff in transform parameters but no luck yet to get it to only post G54

[Guest MTB Technical Services]

I got transform to work had to set plane to TOP in transform parameter. Thanks for all the replys

 

If you symmetrical features, Toolpath X-Form is almost always quicker.

 

When you start getting into features that aren't normal to the part surface or aren't symmetrical, FBM really shines.

[CJep]

Well it verify looks good but when I post it its giving me a different fixture offset for every hole. Any ideas? I keep switching stuff in transform parameters but no luck yet to get it to only post G54

 

In the transform utility you can set the work offset numbering to "assign new" then set the value to zero & zero

or if you are using one of the InHouse posts you can go to the misc values page of the first tpath and activate misc integer #9 to lock on to first work offset

[Dont]

In the transform utility you can set the work offset numbering to "assign new" then set the value to zero & zero

or if you are using one of the InHouse posts you can go to the misc values page of the first tpath and activate misc integer #9 to lock on to first work offset

THANKS

[Dont]

If you symmetrical features, Toolpath X-Form is almost always quicker.

 

When you start getting into features that aren't normal to the part surface or aren't symmetrical, FBM really shinesIts

It is a symetrycal part but I will be checking out FBM soon. Thanks