Haas Mini mill with A axis rotary

[Paul Felger]

Hello, We recently purchased a Haas Mini Mill and a HA5C A axis rotary.

Im not familiar programming the A axis and was hoping you could send me a sample program to go off of.

Basically going to have several plastic rings on a mandral and need notched ever 45 deg.  So I need the A axis to start at 0 deg, stop, then going to make a pass in the X, retract, index 45 deg, make a pass in the X, and so on, 8 times.  So there will be 8 cuts (360 deg) spaced 45 deg from each other.

Thanks for the help and please email me back for questions if I didn't explain this very well.

 

Paul Felger  

[crazy^millman]

I would suggest getting training from your local Mastercam dealer. There are example files to download from the official Mastercam forum. Put up something you need toolpaths on and that will allow others to help you better. Make up something close if you cannot share the file.

[Paul Felger]

I do know mastercam but this company has solid cam

Im in the process of learning it now.

Im jst looking for some simple code to get the rotary to go to a certain deg and will just write the rest by hand.

 

Thanks 

[crazy^millman]

Let me get this straight you need help with Solidcam or you want sample code from Mastercam to help you get a part done? Go to the HAAS website and they have example code for this type of stuff.

[BrianP.]

 

Hello, We recently purchased a Haas Mini Mill and a HA5C A axis rotary.

Im not familiar programming the A axis and was hoping you could send me a sample program to go off of.

Basically going to have several plastic rings on a mandral and need notched ever 45 deg.  So I need the A axis to start at 0 deg, stop, then going to make a pass in the X, retract, index 45 deg, make a pass in the X, and so on, 8 times.  So there will be 8 cuts (360 deg) spaced 45 deg from each other.

Thanks for the help and please email me back for questions if I didn't explain this very well.

 

Paul Felger  

 

 

 

Simple. Post out your program and with a little manual editing no problem. Haas using an A axis just add another address to your X and Y line whatever you want to be at. Cutter comp off. Lead in lead out line only no arc.

 

Original output using 3 axis post.

 

G0 G17 G40 G49 G80 G90

( 0.125 CHAMFER MILL )

T1 M6

G0 G54 G90 X.0625 Y0. S6000 M3

G43 H1 Z.1

M8

G1 Z-.03 F30.

X0.

X-1.4313

X-1.4938

G0 Z.1

M9

M5

G28 G91 Z0.

G0 G53 G90 Y0.

M30

 

Modify first line for A axis

 

G0 G17 G40 G49 G80 G90

( 0.125 CHAMFER MILL )

T1 M6

G0 G54 G90 X.0625 Y0. A0 S6000 M3

G43 H1 Z.1

M8

G1 Z-.03 F30.

X0.

X-1.4313

X-1.4938

G0 Z.1

M9

M5

G28 G91 Z0.

G0 G53 G90 Y0.

M30

 

Copy and paste and edit to do more passes.

G0 G17 G40 G49 G80 G90

( 0.125 CHAMFER MILL )

T1 M6

G0 G54 G90 X.0625 Y0. A0 S6000 M3

G43 H1 Z.1

M8

G1 Z-.03 F30.

X0.

X-1.4313

X-1.4938

G0 Z.1

 

 X.0625 Y0. A45.

G1 Z-.03 F30.

X0.

X-1.4313

X-1.4938

G0 Z.1

 

 X.0625 Y0. A90.

G1 Z-.03 F30.

X0.

X-1.4313

X-1.4938

G0 Z.1

 

 X.0625 Y0. A135.

G43 H1 Z.1

M8

G1 Z-.03 F30.

X0.

X-1.4313

X-1.4938

G0 Z.1

M9

M5

G28 G91 Z0.

G0 G53 G90 Y0.

M30

 

And on around till done. Don't forget the decimal point after A address or you will only get a percentage of a degree. A90. will be 90 degrees A90 will be .9 of one degree.

 

Edit: Noticed the Solidcam addition to subject if Mod wants to delete thats fine with me.

[Paul Felger]

Thanks Brian..

Thats what I needed.

[bensls]

Haas also has a subroutine command (M97) that makes it really easy to do things like this.  Instead of having 8 different copies of the same operation for each angle, you can do something like this:

 

 

G0 G17 G40 G49 G80 G90

( 0.125 CHAMFER MILL )
T1 M6
G0 G54 G90 X.0625 Y0. A0 S6000 M3
G43 H1 Z.1
M8
M97P1000L8

M9
M5
G28 G91 Z0.
G0 G53 G90 Y0.
M30

 

N1000

G90 X.0625
G1 Z-.03 F30.
X0.
X-1.4313
X-1.4938
G0 Z.1

G91 A45.

M99

 

So it makes the cut, rotates 45deg incrementally, then repeats a number "L" times.  Don't forget to check your G90/G91 commands though.  That would make a mess.

[Matthew Hajicek - Singularity]

Or you can use G65 to call a separate program.  Used to do this on the Kitamura horizontals:

 

G54.1 P1

G65 P1001

G54.1 P2

G65 P1002

G54.1 P3

G65 P1001

G54.1 P4

G65 P1002

G54.1 P5

G65 P1001

G54.1 P6

G65 P1002

G54.1 P7

G65 P1001

G54.1 P8

G65 P1002

 

Two stations each on four faces of the tombstone, a part A and a part B, each part probed in.  Put the rotary axis normal position in each work offset.