Jump to content

Welcome to eMastercam

Register now to participate in the forums, access the download area, buy Mastercam training materials, post processors and more. This message will be removed once you have signed in.

Use your display name or email address to sign in:

Mazak Look Ahead ON/OFF codes?


Recommended Posts

Hello everyone,
    I am trying to look for the codes for MAZAK LOOK AHEAD and this if what I found, not sure if these are right or wrong.

G61.1, K40(MAZAK LOOK AHEAD ON)

G61.1(MAZAK LOOK AHEAD OFF)

Thank you.

============================================

N6(ROUGH FACE AND RADII, CUT#36)
G0 G17 G40 G49 G80 G90(11M 41.51S)
G91 G28 Z0. M19
(OPTI-AREA)
T6(1.25, 1-1/4 HIGH FEED, .030RAD, , TiNC,)
(M 373211)
M6
G90 G55 X-.7812 Y-.5903 S3200 M3
G43 H#51999 Z1. T7 (DOC= Z-.59)
G61.1, K40(MAZAK LOOK AHEAD ON)
M7
Z.37
G1 Z.345 F125.
G19(YZ PLANE) G3 Y-.5653 Z.32 J.025 K0.
G17(XY PLANE) G2 X-.216 Y0. I.5653 J0.
G3 X.8862 Y1.3821 Z.2896 I0. J1.1305
X-.7065 Y2.149 Z.2593 I-1.1022 J-.2516
(CUTTING...)
X-1.3082 Z-.49
Z-.465
G0 Z1.

G61.1(MAZAK LOOK AHEAD OFF)
M9

Link to comment
Share on other sites
42 minutes ago, SLuong said:

Hello everyone,
    I am trying to look for the codes for MAZAK LOOK AHEAD and this if what I found, not sure if these are right or wrong.

G61.1, K40(MAZAK LOOK AHEAD ON)

G61.1(MAZAK LOOK AHEAD OFF)

Thank you.

============================================

N6(ROUGH FACE AND RADII, CUT#36)
G0 G17 G40 G49 G80 G90(11M 41.51S)
G91 G28 Z0. M19
(OPTI-AREA)
T6(1.25, 1-1/4 HIGH FEED, .030RAD, , TiNC,)
(M 373211)
M6
G90 G55 X-.7812 Y-.5903 S3200 M3
G43 H#51999 Z1. T7 (DOC= Z-.59)
G61.1, K40(MAZAK LOOK AHEAD ON)
M7
Z.37
G1 Z.345 F125.
G19(YZ PLANE) G3 Y-.5653 Z.32 J.025 K0.
G17(XY PLANE) G2 X-.216 Y0. I.5653 J0.
G3 X.8862 Y1.3821 Z.2896 I0. J1.1305
X-.7065 Y2.149 Z.2593 I-1.1022 J-.2516
(CUTTING...)
X-1.3082 Z-.49
Z-.465
G0 Z1.

G61.1(MAZAK LOOK AHEAD OFF)
M9

I thought G64 turned off G61.1 where did you come up with G61.1 being turned off by using G61.1? Applying the K it is just a tolerance value. Depending on the machine it might need to be a different value. Should check with your Mazak AE and see what they recommend for your machine.

Link to comment
Share on other sites
1 minute ago, crazy^millman said:

I thought G64 turned off G61.1 where did you come up with G61.1 being turned off by using G61.1? Applying the K it is just a tolerance value. Depending on the machine it might need to be a different value. Should check with your Mazak AE and see what they recommend for your machine.

 

Hello Crazy Mill Man,
   I just called Mazak and this is what they told me:

G61.1, K70 (MAZAK LOOK AHEAD ON)
G64 (MAZAK LOOK AHEAD OFF)

or....

G5 P2(MAZAK LOOK AHEAD ON)
G5 P0(MAZAK LOOK AHEAD OFF)

Which one have you seen the most common used?

 

 

Thanks.

Link to comment
Share on other sites
13 hours ago, SLuong said:

 

Hello Crazy Mill Man,
   I just called Mazak and this is what they told me:

G61.1, K70 (MAZAK LOOK AHEAD ON)
G64 (MAZAK LOOK AHEAD OFF)

or....

G5 P2(MAZAK LOOK AHEAD ON)
G5 P0(MAZAK LOOK AHEAD OFF)

Which one have you seen the most common used?

 

 

Thanks.

G61.1 is the Mazak smoothing control.

G5 is the look ahead

You can use both simultaneously, but the must be on separate lines.

  • Thanks 1
Link to comment
Share on other sites
32 minutes ago, So not a Guru said:

G61.1 is the Mazak smoothing control.

G5 is the look ahead

You can use both simultaneously, but the must be on separate lines.

 

Thanks for the tips.

 

 

==============================

N6(ROUGH SECOND STEP, CUT#4)
G0 G17 G40 G49 G80 G90(19.52S)
G91 G28 Z0. M19
(3X RDEPTH CUTS, .025 PER)
T6(1.25, 1-1/4 HIGH FEED, .030RAD, , TiNC,)
(M 373211)
M6
G90 G54 X4.202 Y-1.7956 S1302 M3
G43 H#51999 Z1. T27 (DOC= Z-.0294)
M8
Z.125
G1 Z-.0147 F27.
X3.9811 Y-1.5746
G3 X3.875 Y-1.5307 I-.1061 J-.1061
(CUTTING...)
G1 X4.202 Y1.7956
G0 Z1.
M9
G91 G28 Z0. M5
M1
(*)
N27(ROUGH DAT A AND DAT B +.02, CUT#5)
G0 G17 G40 G49 G80 G90(07M 58.18S)
G91 G28 Z0. M19
(DYNAMIC MILL)
(.0525 STOVR, 7.PERC TDIA.)
T27(.75, 3/4 EM, .030RAD, , TiNC,)
(IMC 66222. COLLET=REG 1732.19050 )
M6
G90 G54 X-3.3656 Y-3.1621 S3500 M3
G43 H#51999 Z1. T6 (DOC= Z-.2162)
G5 P2(MAZAK LOOK AHEAD ON)
M8
Z.1
G1 Z-.2062 F100.
X-3.3694 Y-3.1529
(CUTTING...)
G1 X.9053 Y1.6777 Z-.2062
X.9519 Y1.6972
G0 Z1.
M9
G5 P0(MAZAK LOOK AHEAD OFF)
G91 G28 Z0. M5
G0 G90 G54 X0.
M1
T6 M6(1.25, 1-1/4 HIGH FEED)
M6
#3901 = #3901 + 1
M30(CHARACTERS COUNT = 36,684 - 35.84KB)
#3901 = 0 (OPERATOR MANUAL RESET)
%

 

  • Like 1
Link to comment
Share on other sites

Join the conversation

You can post now and register later. If you have an account, sign in now to post with your account.

Guest
Reply to this topic...

×   Pasted as rich text.   Paste as plain text instead

×   Your link has been automatically embedded.   Display as a link instead

 Share

  • Recently Browsing   0 members

    • No registered users viewing this page.

Join us!

eMastercam - your online source for all things Mastercam.

Together, we are the strongest Mastercam community on the web with over 56,000 members, and our online store offers a wide selection of training materials for all applications and skill levels.

Follow us

×