tooltable & other header info

[kkominiarek]

This will be an ongoing Q&A thread for me.... so please check back often over the next couple of weeks as I will attempt to make my post almost perfect......I've been experimenting w/tooltable/bldnxtool/pwrrt/tcnt....I've read past threads to get this far.

 

1st problem ....tooltable/list at beginning of program.

 

*** this is what I have now....

%

O0000

(PROGRAM NAME - KTEST.NC )

(CUSTOMER NAME - Default Customer )

(DESCRIPTION - Default Description )

 

(TOOL LIST)

 

G20

G0 G17 G40 G49 G80 G90

T1 ( TOOL 1 - .75" ROUGHER )

( ROUGH 2"THRU HOLE )

M6

G0 G90 G54 X-12.8051 Y-3.5139 S2500 M3

G43 H1 Z3.

G5 P10000

( - .75" ROUGHER )

X-12.8051 Y-3.5139 Z.1

( - .75" ROUGHER )

G1 Z-1.45 F25.

( - .75" ROUGHER )

G41 D21 X-13.7851 F45.

( - .75" ROUGHER ).....................

 

T2 ( TOOL 2 - .75 E MILL )

( FINISH .830 DIM )

M6

G0 G90 G54 X-13.1801 Y-10.6962 S3000 M3

G43 H2 Z3.

G5 P10000

( - .75 E MILL )

Z.1

( - .75 E MILL )

G1 Z-.825 F25.

( - .75 E MILL )

G41 D22 Y-10.0962 F48.

( - .75 E MILL )

X-23.537

( - .75 E MILL ).....................

 

T3 ( TOOL 3 - .75 OD X 45 DEG C'SNK )

( MACHINE CHFR ON THRU HOLE )

M6

G0 G90 G54 X-12.8551 Y-3.5139 S3000 M3

G43 H3 Z3.

G5 P10000

( - .75 OD X 45 DEG C'SNK )

Z.1

( - .75 OD X 45 DEG C'SNK )

G1 Z-.238 F50.

( - .75 OD X 45 DEG C'SNK )

G41 D23 X-12.2551 F40.

( - .75 OD X 45 DEG C'SNK )..........

 

***this is what I want....

O0000

(PROGRAM NAME - KTEST.NC )

(CUSTOMER NAME - Default Customer )

(DESCRIPTION - Default Description )

 

(TOOL LIST)

(TOOL 1 - .75 ROUGHER )

(TOOL 2 - .75 E MILL )

(TOOL 3 - .75 OD X 45 DEG C'SNK )

 

G20

G0 G17 G40 G49 G80 G90.......

 

What is causing the toolcomment to be posted after every line and not at the top?

[Storkman]

It's under ptlchg. ptoolcomment. put a # before it to stop it from output.

[kkominiarek]

this is section of my post, I put this "#" in front of #ptlchg, #ptoolcomment and #pbld

 

....these changes did not get rid of the tool comments after every line.

 

- - - - - - - - - - - -

ptlchg #Tool change

pcuttype

toolchng = one

#if mi1 = one, #Work coordinate system

# [

# pfbld, n, *sg28ref, "X0.", "Y0.", e

# pfbld, n, "G92", *xh, *yh, *zh, e

# ]

pbld, n, "M01", e

pcom_moveb

c_mmlt #Multiple tool subprogram call

pcan

pbld, n, *t, ptoolcomment, e

comment

- - - - - - - - - - - - - -

[Storkman]

If you put it in front of pbld it will stop it from reading the whole line. You can delete ptoolcomment and comment. You made a backup copy of this post first I hope.

[Don S at Barefoot CNC South]

kk

Check your email

[kkominiarek]

Don, I actually have these same notes printed from the mcam forum....the problem is...i don't know....

it just doesn't code correctly....i think i'm following your examples to the "T".

 

could it be where these items are in my post?

where should tooltable be?

where should bldnxtool be?

 

thanks for taking time to e-mail me

[Don S at Barefoot CNC South]

It may be were you put them in the post. If you want zip your post and email it to me and I will look at it for you.

[Don S at Barefoot CNC South]

Ken,

Check your email, let me know what you think.

[Don S at Barefoot CNC South]

Ken,

The call up for tool list has to be in pheader not psof I rearranged some things and added date format and remed out duplicate items.

[kkominiarek]

Don.....thanks for the help

[kkominiarek]

my next question......

 

I want the post to prompt me for Print Number.

 

I have e-mailed my reseller to request post cd so I can have the list of all variables. But in the meantime can someone let me know what the variable for print number is?

 

examples....

scustname "Default Customer"

spartdesc "Default Description"

s???????? "Default Print Number"

[Paul Decelles]

sthisiskensprintnumbervariable I believe... I'll have to check the Post Processor Guide to be sure though

[Storkman]

Make your own variable. I do it all the time.

[kkominiarek]

I tried to create one called sprntnumb

 

this is what I had.......

 

# -------------------------

# Start of File and Toolchange Setup

# -------------------------

sprntnumb "Default Print Number" # initilize string variables for questions

 

fq 1 sprntnumb Enter print description: #format questions

 

 

 

pheader

"(PRINT NUMBER - ", sprntnumb, ")", e

 

 

# --------------------------

# Misc strings

# --------------------------

sprntnumb "Default Print Number"

 

 

Was I close??????

[crazy^millman]

I do not think you need the one under misc. I think this is redundent and unneeded.

 

HTH

[kkominiarek]

I put....# (pound) in front of line....this did not work....I did not get prompted to enter print number.

 

# --------------------------

# Misc strings

# --------------------------

# sprntnumb "Default Print Number"

[kkominiarek]

Can anyone steer me in the right direction as far as making my own variable .

[Storkman]

this is out of a setup sheet but the same process should work in a post. This is what I use to input my work zero positions.

 

 

# DEBUG/PROGRAM SWITCHES, debugging and program switches

# --------------------------------------------------------------------------

sxzero "CV Packing Surface"

syzero "Centerline Root"

szzero "Root Bottom"

sazero "Root Bottom facing spindle

 

 

# Question format statements

# --------------------------------------------------------------------------

fq 5 sxzero Enter X Zero

fq 6 syzero Enter Y Zero

fq 7 szzero Enter Z Zero

fq 8 sazero Enter B Zero

 

 

pcollect # Collect info

q5

q6

q7

q8

 

 

pheader # File header

pcollect

 

 

pbld, "(X ZERO =)", sxzero, e

pbld, "(Y ZERO =)", syzero, e

pbld, "(Z ZERO =)", szzero, e

pbld, "(B ZERO =)", sazero, e

[kkominiarek]

Storkman, I appreciate your help but I'm unfamiliar with adding questions/prompts to the post and what needs to be changed/added to what location in the post.

 

I've made numerous changes and nothing has worked.

 

I did order the post cd. Hopefully the cd has what I need on it. With a good "how to" section.

[Storkman]

Ken,

 

that's why I added the title lines to show you where they go.

 

If you like, email me your post and a description of what you would like to add and I'll see if I can fiqure it out and send you back a description of how it was done.

[Don S at Barefoot CNC South]

Ken check your email and let me know.

[kkominiarek]

Don, yes it helped...I still had to edit where the info was placed and what order it was in but I was able to get thru it. Thanks for steering me in the right direction. I also finally realized that psof & pheader are totally independent of one another.

[Don S at Barefoot CNC South]

Ken,

Very good, I hope it works good for ya.

[kkominiarek]

thought I had my tooltable where I wanted it but noooooo......

 

I want to move my tooltable from the pheader to psof

 

I've looked at everything, tried everything........psof postblock, nc output variables, bldnxtool, tooltable, pwrtt, pwrttparam etc...etc.....I

[kkominiarek]

( i wasn't finished )

 

No matter what changes I made, the tooltable always posted in the same section.

 

I need some diection again....How do I move the tooltable?