Fixture offset problems

[ATG]

I'm trying to set my fixture offsets in mastercamx Msr2, but for some reason if I post the entire program the only fixture offset call out am at the beginning off the program e01. If I post each tool path separately then the offset changes to what I want. I'm running a fadal format1 I'm sure what post I'm using the company had it when I got here. I set my tool off sets under planes. Also I was wondering if the misc button has anything to do with it.....

 

Thanks,

 

Seth

[kinglouie V]

If you're running a "X" post supposedly if you call out fixture offset in first operation of misc. page it will affect that offset in all preceding operations. you could try to select

all and edit common parameters. (right click in op mgr)

[ATG]

It seems that whatever I change the misc value to under interger 1 to changes the fixture offset number. But only on the first line of code it wont change each tool path for instance.

 

 

N100E01 (offset 1)******

N110G90G80G40G17G00

N120M6T1*----- TOOL # 1 OFFSET # 1 -----

N130M3S3800

N140G8

N150G0X5.0703Y2.0288

N160H1Z4.M9

N170Z.1

N180G1Z0.F50.

N190G3X5.0703Y2.0288Z-.05I-1.0703J1.9712F45.

N200X5.0703Y2.0288Z-.1I-1.0703J1.9712

N210X5.0703Y2.0288Z-.15I-1.0703J1.9712

N220X5.0703Y2.0288Z-.2I-1.0703J1.9712

N230X5.0703Y2.0288Z-.25I-1.0703J1.9712

N240X5.0703Y2.0288Z-.3I-1.0703J1.9712

N250X5.0703Y2.0288Z-.35I-1.0703J1.9712

N260X5.0703Y2.0288Z-.4I-1.0703J1.9712

N270X5.0703Y2.0288Z-.45I-1.0703J1.9712

N280X5.0703Y2.0288Z-.5I-1.0703J1.9712

N290X5.0703Y2.0288Z-.55I-1.0703J1.9712

N300X5.0703Y2.0288Z-.6I-1.0703J1.9712

N310X5.0703Y2.0288Z-.65I-1.0703J1.9712

N320X5.0703Y2.0288Z-.7I-1.0703J1.9712

N330X5.0703Y2.0288Z-.75I-1.0703J1.9712

N340X5.0703Y2.0288Z-.8I-1.0703J1.9712

N350X5.0703Y2.0288Z-.85I-1.0703J1.9712

N360X5.0703Y2.0288Z-.9I-1.0703J1.9712

N370X5.0703Y2.0288Z-.95I-1.0703J1.9712

N380X5.0703Y2.0288Z-1.I-1.0703J1.9712

N390X5.0703Y2.0288Z-1.05I-1.0703J1.9712

N400X5.0703Y2.0288Z-1.1I-1.0703J1.9712

N410X5.0703Y2.0288Z-1.15I-1.0703J1.9712

N420X5.0703Y2.0288Z-1.2I-1.0703J1.9712

N430X5.0703Y2.0288Z-1.25I-1.0703J1.9712

N440X5.0703Y2.0288Z-1.3I-1.0703J1.9712

N450X5.0703Y2.0288Z-1.35I-1.0703J1.9712

N460X5.0703Y2.0288Z-1.4I-1.0703J1.9712

N470G0Z4. *Right here should switch to offset2*

N480Z.1

N490G1Z0.F50.

N500G3X5.0703Y2.0288Z-.05I-1.0703J1.9712F45.

N510X5.0703Y2.0288Z-.1I-1.0703J1.9712

N520X5.0703Y2.0288Z-.15I-1.0703J1.9712

N530X5.0703Y2.0288Z-.2I-1.0703J1.9712

N540X5.0703Y2.0288Z-.25I-1.0703J1.9712

N550X5.0703Y2.0288Z-.3I-1.0703J1.9712

N560X5.0703Y2.0288Z-.35I-1.0703J1.9712

N570X5.0703Y2.0288Z-.4I-1.0703J1.9712

N580X5.0703Y2.0288Z-.45I-1.0703J1.9712

N590X5.0703Y2.0288Z-.5I-1.0703J1.9712

N600X5.0703Y2.0288Z-.55I-1.0703J1.9712

N610X5.0703Y2.0288Z-.6I-1.0703J1.9712

N620X5.0703Y2.0288Z-.65I-1.0703J1.9712

N630X5.0703Y2.0288Z-.7I-1.0703J1.9712

N640X5.0703Y2.0288Z-.75I-1.0703J1.9712

N650X5.0703Y2.0288Z-.8I-1.0703J1.9712

N660X5.0703Y2.0288Z-.85I-1.0703J1.9712

N670X5.0703Y2.0288Z-.9I-1.0703J1.9712

N680X5.0703Y2.0288Z-.95I-1.0703J1.9712

N690X5.0703Y2.0288Z-1.I-1.0703J1.9712

N700X5.0703Y2.0288Z-1.05I-1.0703J1.9712

N710X5.0703Y2.0288Z-1.1I-1.0703J1.9712

N720X5.0703Y2.0288Z-1.15I-1.0703J1.9712

N730X5.0703Y2.0288Z-1.2I-1.0703J1.9712

N740X5.0703Y2.0288Z-1.25I-1.0703J1.9712

N750X5.0703Y2.0288Z-1.3I-1.0703J1.9712

N760X5.0703Y2.0288Z-1.35I-1.0703J1.9712

N770X5.0703Y2.0288Z-1.4I-1.0703J1.9712

N780G0Z4.

 

 

Not sure why it wont post like it should.

[kinglouie V]

I see now, double check your wcs

 

 

:edit:

 

by that I mean, if you're inputting a 2 in your interger field for offset two then check wcs to indicate offset 2.

 

/edit

[ATG]

I Checked the wsc and the box is checked and i have the work offset number the same as the misc. No change still post the same.

[ATG]

I've noticed that if I change tools it will post the offset. But if I use the same tool and change the offset, as to duplicate a part it will not post the change.

[67 Yankee]

Make sure you assign a work offset to the first operation or it will start your program with the first assigned offset it finds.

[ATG]

I've assigned an offset to each tool path including the first one. Still no luck, I wonder why it will change with a tool change in-between each offset

[Tim Johnson]

Does your Misc intergers have a "Lock on First WCS [0=No,1=Yes]" setting? If so make sure that it's set to 0 in the first operation.

[jagg2499]

if you are trying to cut 2 different parts with 2 different wcs and the same tool check the force tool change button it will post a new offset for you

[ATG]

The Force tool change worked Great......

 

 

Thanks,

 

 

Seth