PUT LAST TOOL AWAY OKUMA MILL

[HEAVY METAL]

Does anyone know the code to put the last tool away for a okuma mill. The problem I.m having is the the program won't stat if tool in already in spindle.

Thanks Heavy

[Rick Henrickson The Boeing Co.]

its called no next tool m69 maybe I dont have a manual here

[Rick Henrickson The Boeing Co.]

Actualy the program will start if you build a little macro in your post

 

If vatol=1 n1

t1 m6

n1 go g15 hi x y s m

[Mick]

M63

M6

 

The M63 will call up an empty pot

[cadmonster66]

Heavy,

With our Okuma's we have a variable set up in the post like this.

Example for tool 1

 

IF[ VATOL EQ 1 ] N100

T1 M06 (1.000 FLAT ENDMILL)

(ROUGH 3.500 TO +.025)

( MAX | Z.1 )

( MIN | Z-1.75 )

N100 G15 H2 T2

M01

 

the N number will change with each tool number and at the last tool on the G15 H2 line we have the post so it will all call first tool to ready position. This will avoid any tool change errors you may get

HTH

John

[Greg Williams]

M63

M6

[Mick]

Yeah, Greg should know... LOL

[Goldorak]

G30 P1 should do the job

it returns tool at tool change position

 

my post output a code like this at the end

 

 

T1M6 (call first tool)

X-15 Y15 Z15 A0 (clear tool from piece)

M02

 

 

this works for 90% of my programs

[Mick]

What happens for the other 10% of your programmes axela 06?

[HEAVY METAL]

thanks i will give these a try

[gms1]

We use a G116 macro for all tool changes. It checks to see if the tool is there if it is, it doesnt change, if it isnt it orients spindle and changes. So instead of M6 we get G116 T1

[Greg Williams]

For those interested G116 is a custom Macro

 

I use this one

 

OTCK(GET NOMINATED TOOL G116)

IF [PT EQ EMPTY] NERR

IF [PT EQ VTLCN] NEND

IF [PT EQ VNTOL] NM6

IF [VNTOL EQ 0] NCT

M64

NCT T=PT

NM6 M6

NEND G56 H=PT D=PT

GOTO NRTS

NERR M63

M6

NRTS RTS

RTS

[Goldorak]

quote:

---

What happens for the other 10% of your programmes axela 06? [smile]

---

Crash..................j/k

 

 

no i edit my code to fit the end of program , usually when the part is bigger than the machine capacity

[Kyle Waters]

Greg,

How did you pass the user variable? Did you set it up as a library file? So, G116 PT=01?

[Kyle Waters]

Sorry. forgot to add that I can't pass a user variable outside the program that I stated it, thus the reason for the question.

[Greg Williams]

Kylie,

 

Save the code as a *.lib file

 

Then register the library file

 

The Gcode is

 

G00 G17 G21 G40 G80 G90

G30 P1

M404

(SWARF NEW TOOLPATH)

(TOOLPLANE NAME - TOP)

G116 T5 ( 16. FLAT ENDMILL)

M27 (C-AXIS UNLOCK)

M11 (A-AXIS UNLOCK)

G15 H1

G01 G17 G90 G94 A-19.1423 C58.4052 F20000.

S8000 M3

G56 H5

G169

G01 X11.256 Y-18.073 Z150. M8

G131 F6000. J0 E.02 D.01 I2 L5. R.3 K1

 

Any probs send me an email

 

More info here

[Kyle Waters]

Cool! Thanks for the info Greg. I haven't been called Kylie in years!

[Greg Williams]

Whoops sorry, Typing is not one of my better skills

[Kyle Waters]

no sweat Greg, I plan to try that out on one of our MC4VA with a OSP5000 control hopefully before the weekend. Thanks again.

[Greg Williams]

Kyle,

 

I have not tried this on a 5000 control, if you have any problems let me know.