Need a Fadal Post (** uses mult. offsets e1-e2 **)

[RunFasterTony]

Does anyone have a Fadal Post capable of using multiple offsets (** E1-E2-E3 etc **).

If you do could you please shared with me.

Thanks in advance.

[Hardmill]

Read the FAQs and do as your name says.

 

Did you talk to your reseller?

 

 

PEACE

 

[ 08-22-2003, 11:46 PM: Message edited by: Hardmill ]

[Guest CNC Apps Guy 1]

Your reseller can be reached at (909)923-9299. They would be more than happy to part with the post you need, and moer than likely for free even. Give thema call.

[RunFasterTony]

Thanks for your reply.

I work for a Mold company, and yes we have licence copies of Master Cam.

I allready contacted Master Cam ( last monday )

and I am still waiting for their reply.

[Guest CNC Apps Guy 1]

You may want to try talking to Glenn.

[Trevor Bailey]

What is wrong with the Fadal post out of the box? It should post to multiple offsets when the software is config'ed right.

[chris m]

+1 Trevor, I just ran a quick toolpath, transformed it and MPFADAL1 posts E1,E2,E3 for the transformed ops no prob

 

C

[Jayson Kramer]

RunFasterTony, Contact Glen out of our office this will be your best bet.

We do have a really nice Fadal post. We even have one that supports Fadal Sub real well.

[crazy^millman]

But do what you want I took the Fadal Post right out of the box and yes it supports E fixture offset. It also support subs and it also supports the can cycles. I would tweak the one out of the box for your machine and how you have them set-up and if you dont know post processors I recommned calling your dealer.

 

Crazy Millman

[RunFasterTony]

Thank to all of you that reply.

I will call Glenn at (909) 923-9299 on monday,

and for those of you that used mpfadal1 and got it to work using e1-e2 etc, coul you try rearrenging the tool-paht so that tool finish e1 go to e2 and then change tools ( to save time in tool changes ).

(** it did not work for me **).

[Hardmill]

Perhaps you want (as Jay said) subs.

If im not mistaken I've had the same issue

in the past. Sub progs. solved it.

 

PEACE

[crazy^millman]

Tony Run Faster it is easy to do what you want and you dont have to do it with subs. It requires a little up front thought or just some cutting and pasting or your operations. i will sometimes have 10 different E fixture offset in my program and it post them all the way i want. You need to go into your post and tell it not to force out an fixture offset at every too change.

 

Added this for reference:

 

force_wcs : no #Force WCS output at every toolchange?

 

It will insure that it will not override the changes in E offsets by doing it this way. You also call your fixure offsets in the TC plane dialog box using the MPFADAL post check the workoffset an then put in the number. I would also throw this trick out here I use the MPFADAL2 post proccesor for the Format 1 set-up works real good and seem to give me less trouble. This is not recommned by Mastercam or Fadal but I have played with my post to do all of My format 1 can cycles using the format 2 post processor.

 

Crazy Millman

 

[ 08-25-2003, 11:39 PM: Message edited by: Millman^crazy ]

[crazy^millman]

Hey Tony you never told us if you got it going or not but wanted to show you this simple drilling program i am doing with my post.

 

O9999(FIXTURES HOLES)

(28-08-03 / 16:52)

G0G17G40G49G80G90

(.156 DRILL TOOL - 13 DIA. OFF. - 0 LEN. - 13 DIA. - .136)

T13M6

G0G90S1200M3E10X-7.175Y3.753

H13Z.1M8

G4 P1000

G8

G83G99X-7.175Y3.753Z-2.2R0.1Q.1F4.

X-7.175Y-3.753Z-2.2

X7.175Y-3.753Z-2.2

X7.175Y3.753Z-2.2

G80

E20X-7.175Y3.753Z.1

G83G99X-7.175Y3.753Z-2.2R0.1Q.1F4.

X-7.175Y-3.753Z-2.2

X7.175Y-3.753Z-2.2

X7.175Y3.753Z-2.2

G80

M5M9

G91 G28 Z0.

M1

(.177 DRILL TOOL - 14 DIA. OFF. - 0 LEN. - 14 DIA. - .136)

T14M6

G0G90S800M3E10X-7.175Y3.753

H14Z.1M8

G4 P1000

G8

G83G99X-7.175Y3.753Z-1.5R0.1Q.1F4.

X-7.175Y-3.753Z-1.5

X7.175Y-3.753Z-1.5

X7.175Y3.753Z-1.5

G80

E20X-7.175Y3.753Z.1

G83G99X-7.175Y3.753Z-1.5R0.1Q.1F4.

X-7.175Y-3.753Z-1.5

X7.175Y-3.753Z-1.5

X7.175Y3.753Z-1.5

G80

M5M9

G91 G28 Z0.

M02

 

See how it puts the E20 where I want it. i am also doing about 40 operations on these 2 fixture after this with about 10 tools so by thinking about these operations I can get the whole thing posted and doing what I want from the correct spindle speeds and everything. This is the Mpfadal2 post right out of the 9.1sp1 pack with some changes.

 

Hope you have got it all going the way you wanted.

 

Crazy Millman