Mill Turn Delimas

[rrichard]

    We waiting on training for MT and we this rush project we just can't figure out how to machine.

  The last and only feature we having trouble with is 45 degree face with 8 cleats milled. We wanting to use C axis with the head @ 45 degrees.

 

    I have a MC X9 file attached with no tool path for size. For some reason I can't Z2go it keeps coming up empty in 2017?

  Can someone do a quick example please, really need help with this one.

Thanks

 

T2.mcx-9

[JoshC]

Looks to be a Perfect part for the Multi-axis Swarf, i can do an example but did you purchase the Multi-axis module or the Swarf path for your Mill turn product? If not i am confident there are still toolpathing solutions but the Swarf in my opinion would be the easist, fastest and best for a part/Chamfer of that nature.

[rrichard]

Yes we have all the modules please do this for us

Thank you

[JoshC]

No problem, I can not spend all day on this obviously but would be glad to help you some, I did this in X9 because I though you only had X9 but if you have 2017 I would encourage you to stick with 2017 instead of x9 since they made many MT improvements in 2017 compared to x9.

 

Here is a sample file link: https://www.dropbox.com/s/cxomqo97al14dpd/T2-SAMPLE.mcx-9?dl=0

Here is a sample video link: https://www.dropbox.com/s/0odi1fryf3l6uj3/sample.mp4?dl=0

[crazy^millman]

I would have just used the wall surfaces and called it done, but to each their own.

 

Here is what I came up with in a few clicks of the mouse in 2017 with no geometry needing to be created what so ever.

 

https://www.dropbox.com/s/bhtcpz7x1v1fkzs/5th_axis_T2.mcam?dl=0

[gcode]

I would have just used the wall surfaces and called it done, but to each their own.

 

Here is what I came up with in a few clicks of the mouse in 2017 with no geometry needing to be created what so ever.

 

https://www.dropbox.com/s/bhtcpz7x1v1fkzs/5th_axis_T2.mcam?dl=0

Looks like it takes a mill/turn license to open this

 

MC2017 opens it with the Toolpath Manager greyed out

MC2018 TP2 opens it and tells you the Sim it not enabled for features in this file

[rrichard]

Thank you so much Josh and Ron, looks like 2017 is the ticket,  ya'll make it look easy.

Thanks again

Russell

[rrichard]

  Morning,

    I hope I can re post this thing again?

  Here is our real problem, our Okuma Multis is not a full 5 axis, or the B axis has to be in a fixed position and can't move simultaneous with the other axis. 

     We've been trying to run it as a fixed B angle with 4 axis, just tried all different ways, did a contour the tried a convert to 5 axis but just too dumb to get it to work.

       Can this be done?

   If I need to post another file I can.

  Thanks

Russell

[crazy^millman]

I went back to the old school swarf in Mill/Turn since the newer ones don't allow for locking the toolpath to 4 Axis output. but it wouldn't lock the head at 45 maybe because I was starting in top plane and not using a plane at 45 degree. Pretty much the same way I did before only using the surfaces and got the following output.

G140
(DATE=DD-MM-YY -  12/20/2016  TIME=HH:MM -  9:48 AM)
(MCX FILE -  C:\Users\ron\Documents\my mcam2017\mcx\5th_axis_T2.mcam)
(NC FILE -  C:\Users\ron\Documents\my mcam2017\Mill Turn\NC\T2.MIN)

(1  |  1/4 BALL ENDMILL  | DIA. -  0.25)

(MAX SPINDLE SPEED FOR MAIN SPINDLE)
G140
G00 X60. W60. (MOVE SUB SPINDLE HOME)
G20 HP=4
G50 S3800
(MAX SPINDLE SPEED FOR SUB SPINDLE)
G141
G50 S3800

G140
(Operation # 2)
M110
(1  |  1/4 BALL ENDMILL  | DIA. -  0.25)
NP001
MT=101
M321
G20 HP=4
TL=010101 BT=0
NT001
SB=2000 M13 M241
M146
G20 HP=4
G00 C337.508 M16
G138
G94 G00 G17 Z-.0806
X5.6457 Y-2.1709
G94 G01 X5.0701 Y-1.9326 Z-.7008 B45.13 F10.
X5.0579 Y-1.9252 Z-.7448 B44.92 C337.465
X5.0402 Y-1.9137 Z-.7807 B45.057 C337.531 M15
X5.0263 Y-1.8993 Z-.8149 B45.005 C337.459 M16
X5.0155 Y-1.883 Z-.8449 B44.99 C337.451
X5.0095 Y-1.8659 Z-.8668 B45.024 C337.546 M15
X5.0139 Y-1.841 Z-.8757 B45.02 C337.466 M16
X5.0391 Y-1.7696 Z-.8762 B45.013 C338.458 M15
X5.0656 Y-1.6921 B45.009 C339.439
X5.091 Y-1.6141 B45.006 C340.42
X5.1152 Y-1.5358 B45.005 C341.401
X5.1381 Y-1.4571 B45.004 C342.381
X5.1599 Y-1.378 B45.005 C343.361
X5.1804 Y-1.2987 C344.34
X5.1998 Y-1.219 B45.006 C345.318
X5.2179 Y-1.139 B45.007 C346.295
X5.2347 Y-1.0588 B45.006 C347.27
X5.2504 Y-.9783 B45.004 C348.247
X5.2648 Y-.8976 B45.001 C349.224
X5.2779 Y-.8166 B44.997 C350.201
X5.2898 Y-.7355 B44.993 C351.179
X5.3005 Y-.6542 B44.989 C352.158
X5.3099 Y-.5728 Z-.8763 B44.985 C353.137
X5.3181 Y-.4912 B44.981 C354.117
X5.325 Y-.4095 B44.978 C355.097
X5.3307 Y-.3277 B44.975 C356.078
X5.3351 Y-.2459 B44.973 C357.058
X5.3382 Y-.1639 B44.972 C358.039
X5.3401 Y-.082 C359.02
X5.3407 Y0. B44.973 C0.
X5.3401 Y.082 B44.975 C0.982
X5.3382 Y.1639 B44.977 C1.962
X5.3351 Y.2459 B44.98 C2.943
X5.3307 Y.3277 B44.984 C3.922
X5.325 Y.4095 Z-.8762 B44.988 C4.901
X5.3181 Y.4912 B44.992 C5.88
X5.3099 Y.5728 B44.996 C6.858
X5.3005 Y.6542 B45. C7.835
X5.2898 Y.7355 B45.002 C8.812
X5.2779 Y.8167 B45.004 C9.785
X5.2648 Y.8976 B45.003 C10.762
X5.2504 Y.9783 B45.001 C11.738
X5.2347 Y1.0588 B44.997 C12.715
X5.2179 Y1.139 B44.993 C13.694
X5.1998 Y1.219 Z-.8763 B44.989 C14.673
X5.1804 Y1.2987 B44.986 C15.654
X5.1599 Y1.378 B44.984 C16.636
X5.1381 Y1.4571 B44.983 C17.619
X5.1152 Y1.5358 B44.985 C18.602
X5.091 Y1.6141 B44.989 C19.586
X5.0656 Y1.6921 B44.996 C20.57
X5.0391 Y1.7696 Z-.8762 B45.006 C21.554
X5.0138 Y1.8412 Z-.8757 B45.02 C22.533
X5.0095 Y1.8655 Z-.8671 B45.015 C22.514 M16
X5.0157 Y1.8828 Z-.8451 B45.017 C22.505
X5.0261 Y1.8995 Z-.8151 B44.967 C22.54 M15
X5.0397 Y1.9138 Z-.7803 B45.14 C22.404 M16
X5.0579 Y1.9252 Z-.7448 B44.914 C22.54 M15
X5.0701 Y1.9326 Z-.7008 B45.122 C22.493 M16
G00 X5.6455 Y2.1708 Z-.0807
G136
G20 HP=4
M12
M01
M109
M02

Problem is the Multus Bug in Mill/Turn M15/M16 trying to change rotation when it shouldn't and it will not lock B, but I have just modified the code and called it good enough removing the extra B moves. I could sit here and play with it using Curve 5 Axis or maybe morph between 2 curves or parallel to surface.

 

Problem is the natural shape of the part requires the head to tilt a little to cut it perfectly. Since you don't have that ability you will need to cheat geometry to make a trick toolpath cut close enough to what you want.

[rrichard]

Thanks Ron for the reply,

we'll figure it out

Russell

[ABOUSALAH]

hello 

license MILL/TURN it is dongle or file  can be put in program file ?

thanks 

[Guest]

 

hello 

license MILL/TURN it is dongle or file  can be put in program file ?

thanks 

 

A Mill/Turn license is something that needs to be purchased and added to a SIM/Nethasp

 

It comes with a machine specific environment that will ONLY run on the sim to which it is licensed.