Jump to content

Welcome to eMastercam

Register now to participate in the forums, access the download area, buy Mastercam training materials, post processors and more. This message will be removed once you have signed in.

Use your display name or email address to sign in:

determine if this box is checked in post or not


Recommended Posts

If not, you can add them, add this line in your General output settings:

miscvalon  : 0      #Flag for warning that misc values are set to post default

Add this line in your pparameter$ postblock:

if prmcode$ = 15182, miscvalon = rpar(sparameter$,1)

and create this postblock:

pmisccheck #Check if Misc Values are enabled
      if miscerror & miscvalon = 0,
        [
        result = mprint(smiscerror)
        spaces$ = 0
        *e$
        scomm_str, smiscerror, scomm_end, e$
        spaces$ = sav_spc
        if result = 2, exitpost$
        ]
Edited by So not a Guru
accuracy
Link to comment
Share on other sites
30 minutes ago, So not a Guru said:

Do you have this line in your posts General output settings?


miscerror   : 0     #Error out if Misc Values button is disabled, 0=no, 1=yes 

And this in your Error messages section?


smiscerror  : "WARNING - MISC VALUES SET TO POST DEFAULT FOR CURRENT OPERATION"

 

 

This was it, oh snap that was easy.  Thanks Zeke!

Link to comment
Share on other sites
On 25.6.2017 at 2:19 AM, jlw™ said:

 

 

This was it, oh snap that was easy.  Thanks Zeke!

Thank You from me too!, I was looking for the opposite, that is it not checked, as I have two doosan dnm, one 650 and one 6700, which has on the 6700 only new G05 look ahead and not using G08 which is a lower option,. When I programmed before I got the dnm 6700 in january i used G08 in some programs, and when i run those now it errors out, with this add in the pst file with  :

  if miscerror & miscvalon = 1

instead of 0

i got what I needed for my output.

So, now its testing and see if its ok in the future!, thank You!

Link to comment
Share on other sites

Join the conversation

You can post now and register later. If you have an account, sign in now to post with your account.

Guest
Reply to this topic...

×   Pasted as rich text.   Paste as plain text instead

  Only 75 emoji are allowed.

×   Your link has been automatically embedded.   Display as a link instead

×   Your previous content has been restored.   Clear editor

×   You cannot paste images directly. Upload or insert images from URL.

 Share

  • Recently Browsing   0 members

    • No registered users viewing this page.

Join us!

eMastercam - your online source for all things Mastercam.

Together, we are the strongest Mastercam community on the web with over 56,000 members, and our online store offers a wide selection of training materials for all applications and skill levels.

Follow us

×
×
  • Create New...