4TH AXIS RIGHT SIDE

[mirek1017]

Hello All ,question

I program some simple spiral on 4 th axis .I use axis subst. When I make  verify show mi everything good ,but  on my machine running other side .On my mastercam INDEXER is on left side ,but on machine is on right .Haw I can change this ???

 

thanks

[crazy^millman]

Here you go, already done and we even have a Tailstock and Quill in the Machien Sim file. You will see 2 sets of Jaws. One set of jaws is also adjustable for the size of stock you want to grip onto for OD gripping. I didn't add the same ability to the ID gripping. I also made the Logo the correct colors also. The other set is just dumb like the normal process for jaws is with Mastercam and Machien sim. 

4th Axis Right Side VMC

Here is the machine sim example running.

Machine Sim Example

[crazy^millman]

Here is the Mastercam file from a model I got off the forum soem years ago. I trimmed it and added a boss to grab withthe 4th Axis OD jaws. 

Mastercam 2017 file

[mirek1017]

On 8/5/2017 at 2:57 PM, C^Millman said:

Here is the Mastercam file from a model I got off the forum soem years ago. I trimmed it and added a boss to grab withthe 4th Axis OD jaws. 

Mastercam 2017 file

Millman ,thank you for your reply,but haw I can change the rotation in mastercam.The g-codes what I send on machine rotate the indexer on the reverse side .Or there is something in postprocesor ???

[mfgeng director]

go into machine definition and change the rotation of the 4th axis.

As long as your post will allow this it will change the direction.

[mirek1017]

1 hour ago, mfgeng director said:

go into machine definition and change the rotation of the 4th axis.

As long as your post will allow this it will change the direction.

thanks ,got it.I have one more question .When i set feed on rough tool  10.  my post calculate over 200. on the indexing .There is way too fast .Haw I can set up feed on mastercam for calculate right feed on indexing ???I run  HAAS VF 11 

 

thanks 

[Greg_J]

Do you have RCTF checked in your program?

In your Control Def under Feed what are the settings? Inverse?

[mirek1017]

Good morning  Greg J ,this my settings on mastercam 

[Chris In-House Solutions]

Hey Master80,  You need to set your Rotary feed to unit/min.  Then the post should output your programmed feedrate in either in/min or mm/min.

[mirek1017]

thanks Chris ,I run 4th axis job maybe ones one yer ,and I not have chance haw set up everything right .

 

thank you one more time 

[mirek1017]

Chris I posting my rough tool .I set up my feed 10. ant this is what posting my postprocesor 

(ROUGH SLOT .005 STOCK 0N X AND Z)
(COMPENSATION TYPE - WEAR COMP)
N1 T2 M06 (5/8 FLAT  CARBIDE ROUGHFER )
G00 G90 G54 A352.912 X-.513 Y0.
S855 M03
G43 H2 Z5.1829
M08
Z2.3829
G01 Z1.9889 F150.
G41 D2 X.5213 A319.131 F216.05
X.5413 A318.478
X4.6163 A185.399
G40 X4.699 A182.697
G00 Z2.7389
X-.5992 A350.716
Z2.3829
G01 Z1.9889 F150.
G41 D2 X.4351 A316.936 F216.04
X.4551 A316.282
X4.5301 A183.204
G40 X4.6128 A180.501
G00 Z5.1829 M09
M05
G91 G28 Z0.
G28 Y0. A0.
G90
M30

this is way to fast on my indexer 

I set up part dia on my haas control and I change setting what you pointing  me 

 

 

 

[mirek1017]

2 minutes ago, master80 said:

Chris I posting my rough tool .I set up my feed 10. ant this is what posting my postprocesor 

(ROUGH SLOT .005 STOCK 0N X AND Z)
(COMPENSATION TYPE - WEAR COMP)
N1 T2 M06 (5/8 FLAT  CARBIDE ROUGHFER )
G00 G90 G54 A352.912 X-.513 Y0.
S855 M03
G43 H2 Z5.1829
M08
Z2.3829
G01 Z1.9889 F150.
G41 D2 X.5213 A319.131 F216.05
X.5413 A318.478
X4.6163 A185.399
G40 X4.699 A182.697
G00 Z2.7389
X-.5992 A350.716
Z2.3829
G01 Z1.9889 F150.
G41 D2 X.4351 A316.936 F216.04
X.4551 A316.282
X4.5301 A183.204
G40 X4.6128 A180.501
G00 Z5.1829 M09
M05
G91 G28 Z0.
G28 Y0. A0.
G90
M30

this is way to fast on my indexer 

I set up part dia on my haas control and I change setting what you pointing  me 

 

 

 

ok got it ,its posting feed 10. now.

 

thanks 

[mirek1017]

Good morning  Guys !!!

When I drilling same sample holes on my 4 th axis my post generate position  for ex  

G0G90X0Y0 A10

A350.

is it option set up post for  generate  

X0Y0 A10. 

A-10.??

thanks for reply 

[crazy^millman]

That is controlled through the MMD  if connected to it. Through the post for that kind of control you will need a custom post.

[mirek1017]

ok,thanks