Arc Filter setting

[cadist]

Hi everyone,

My problem is even after keeping arc filter to xy plane only after posting some time it gives a helical arc that is all 3 planes in one line.

We got Mikron's machine with hiedenhein controller and the post processer is given from reseller itself.

Previously I was working on siemens controller so these codes are totally different for me. It shows error in block so and so..

CC x32.65 y23.23 z32.43

and machine haults.

If I change the tolerance that block goes off and the program starts running. But for that I have to test each program on the machine or have to use contour everywhere.

can any one help on this.

[Fig sign]

In what toolpath -Shallow and scallop ?

What MC version ?

[cadist]

In both scallop and shallow, using mc9.1

[Fig sign]

in filter settings select only create arcs in xy plane deselect two others and try once more

[cadist]

I tried that also and I even tried filter in one direction only but couldn't solve it.

[Fig sign]

find this and change to 0 in your post

helix_arc : 1 #Support helix arc output, 0=no, 1=all planes, 2=XY plane only

[cadist]

quote:

---

helix_arc : 1 #Support helix arc output, 0=no, 1=all planes, 2=XY plane only

---

Does not exist in my post, I remembered we used to make that setting for siemens and fanuc controller but it is not here in this post processor file should I add it.

[Fig sign]

Yesss

[cadist]

Showing error in post processor

[Fig sign]

IMHO this feature is added when you run UpdatePST9.dll ,and you must run it after every version update .

Remove your changes and run UpdatePST9.dll.

After that fix the value of helix:arc

 

HTH

[cadist]

Iskander we have post given from the reseller of mcam with every update of versions they are giving new post processer, and such problem was not there in previous versions.

[Fig sign]

This feature is added in release 9.1 and you must update your post.

Period !

Trust me

Save your post and txt files somewhere for a backup and run update .

You can not loose nothing .

To run update is a must after every point release and service pack,you have new features ,that your post deals with not correctly

Yes ,Sir !

[G Caputo]

Cadist,

You are showing a cc with x,y & z defined. I don't believe that is possible to even go to the control and type that in, is it? To do a 3-axis helical interpolation it should have a cc defined with 2-axis and then a move that shows something like this. CP IPA+360 Z-.25 RO F200. That would be with a CC of X and Y. What control is it?

 

Greg

[cadist]

now it is night will try it tomorrow bye

[Fig sign]

I run updatepst*.dll after every update or sevice pack and never had problems

[DavidB]

Make sure the smallest arc is no less than .06mm on a surface toolpath and the tolerance no more than 0.005mm on a 2D toolpathe or you will get an era.Put the lookahead to 1000 also.

 

[cadist]

quote:

---

You are showing a cc with x,y & z defined. I don't believe that is possible to even go to the control and type that in, is it? To do a 3-axis helical interpolation it should have a cc defined with 2-axis and then a move that shows something like this. CP IPA+360 Z-.25 RO F200. That would be with a CC of X and Y. What control is it?

---

G caputo we have heidenhien TNC 407 and 430 on UME 900 AND VCP600(Mikron) respectively, Both are giving this error.

[Allan Brown]

+1 G Caputo

 

We use

 

helix_arc : 2

for the XY plane only

 

Then trap helical moves and treat them different than planar arc moves.

 

You need this format

 

CC X Y

CP IPA Z

[Lucky]

cadist,

 

I have a Mikron VCP600 with Heidenhain TNC430 control. We had the exact same problem using the MPHEID.PST supplied by Mastercam. I made the following changes to the post to correct the problem. Perhaps not an elegant solution, but it works:

 

pxyarc #circular interpolation XY plane

if plane = 0, pxypxc = xc

if plane = 0, pxypyc = yc

if plane = 1, pzypyc = xc

if plane = 1, pzypzc = yc

if plane = 2, pzxpxc = xc

if plane = 2, pzxpzc = yc

n, strcc, *pxypxc, *pxypyc, e

n, strc, *x, *y, *sgcode, pcc, pfr, pspdl, e

 

pzyarc #circular interpolation ZY plane

if plane = 0, pxypxc = xc

if plane = 0, pxypyc = yc

if plane = 1, pzypyc = xc

if plane = 1, pzypzc = yc

if plane = 2, pzxpxc = xc

if plane = 2, pzxpzc = yc

n, strcc, *pzypyc, *pzypzc, e

n, strc, *y, *z, *sgcode, pcc, pfr, pspdl, e

 

 

pzxarc #circular interpolation ZX plane

if plane = 0, pxypxc = xc

if plane = 0, pxypyc = yc

if plane = 1, pzypyc = xc

if plane = 1, pzypzc = yc

if plane = 2, pzxpxc = xc

if plane = 2, pzxpzc = yc

n, strcc, *pzxpxc, *pzxpzc, e

n, strc, *x, *z, *sgcode, pcc, pfr, pspdl, e

 

 

pcir # Circular interpolation 2

#n, strcc, xc, yc, e

#n, strc, x, y, *sgcode, pcc, pfr, pspdl, e

if plane = 0, pxyarc

if plane = 1, pzyarc

if plane = 2, pzxarc

 

Good Luck

[mayday]

request the MPmaster_Heid post. it has what you are looking for. I use it on 310 and 430 controls

[cadist]

Lucky Lucky you ar so lucky for me u saved the day

very very thanks

[Lucky]

You're Welcome!

[foolsh]

Lucky,i wonder whether you could tell me where i can just paste all those codes in without having errors in the post MPHEID.PST given by mastercam.by the way the post is for inch

[G Caputo]

foolsh,

What problem are you having? Toolpath? Error? Etc. If it's a post issue, I probably won't be any help, but if it's not, I'll give it a try.

[foolsh]

it was this arc endpoint incorrect error in a surface rough pocket using a 4 mm cutter.i used all the recommendations suggested by all of you members but to no avail.Lucky was suggesting some codes to be changed in the post but there was errors in the post if i just pasted all those codes in.but funnily if i use a 3 mm cutter the alarm error goes away.any suggestions?