5ax Integrex Programming

[IntegrexMan]

Ok...so we have installed an option for full 5 axis motion on out Integrex 100 IIIS machine, but it does not like the G43.4 command. That option is installed as well. We have the Mazak guy here, but he doesn't know why it doesn't like that command. Does anyone know if there is a parameter that needs to be changed?

 

Thanks,

Craig

 

Here is what my code looks like:

 

N10

(CHAMFER WINDOW)

G28 U0.

G28 Y0.

M302

M200

T006000.00

G128 E1

G54

G97 S2000 M203

M248

M250 M212

G98 G0 B90. C78.3954

G0 G18 X38.27 Z-20.2 G43.4 H0

Y-.095

G98 G1 X18.27 F400.

Y-.448 Z-20.054

Y-.595 Z-19.7

[gcode]

Doesn't that H0 need to be an H6... because you're

using tool #6??

[IntegrexMan]

I tried that and it didn't make a difference.

[robk]

Sorry don't have the time to really look @ your sample, but here is a part of my code... It's from a vertical Integrex, but should help you nevertheless

 

N18 T40 M06 T28

#3901 =#4114

/7G65 P9862 B3. T40 D40 I.500 /2S3000

()

()

( Tool Name : T40_.500_ISCAR Tool Diameter: 0.500)

()

(Path Name : FINISH MILL SIDE LUGS_3.190 DIM. AND .300 WIDTH)

()

G20 G69 G80 G40 G49 G17 G90 G94

G10.9 X0. (SET RAD MODE)

G91 G28 Z0.

G28 X0. Y0.

(FINISH MILL SIDE LUGS_3.190 DIM._1)

M200 (C AXIS CONNECTION)

M108 M212 ( B AXIS UNCLAMP C AXIS UNCLAMP)

G53 G90 G00 B90.

G55

G00 C41.562

S458 M03

G00 G43.4 H40 X19.455 Y-3.9351 Z25. B90. C41.562

G61.1 M08 (HIGH ACCURACY MODE)

G00 Z3.44

G00 X17.750

G01 X17.450 F10.

G41.5 G01 Y-3.6851 F1.83 D40

Y-2.95

G40 Y-2.825

G00 X18.560

G49 (CANCEL TLO)

(FINISH MILL SIDE LUGS_.300 WIDTH. SIDE 1_ _LUG 1)

C41.562

G00 G43.4 H40 X18.2473 Y-4.0898 Z1.5849 B92.25

Z1.6241

G01 F25. X17.2481

G41.5 G01 Y-4.0648 F1.83 D40

Y-3.8006

Y-3.8

X17.3266 Z3.6226

Y-4.0668

G40 Y-4.0918

G00 X18.4257

[robk]

...try putting the B and C axis movements on the G43.4 line along with XY and Z

[Ron Branch @ Verisurf]

Here is some sample code from the E series Integrex.

 

code:

---

(PROGRAM NAME - E99460)

(CUSTOMER - ADD CUSTOMER)

(PART NUMBER - 115U9165-1/115U9166-1 REV NC3)

(MODEL # - 115U9165-1/115U9166-1 REV NC3.CATPART)

(PROGRAMMER - RON

(DATE - JUN-19-2008)

(TIME - 12:52 PM)

(PROGRAM REV - N/C)

(POST LICENSE - V&M PRECISION)

(T3 | 3/4 BULL ENDMILL .125R | EIA SUFFIX - 0. | MAZATROL SUFFIX - .00)

G20 G49 G69 G80 G40 G18 G90 G94

M205

 

N1

(T3 | 3/4 BULL ENDMILL .125R | EIA SUFFIX - .00 | MAZATROL SUFFIX - .00)

(1ST CUT CHAMFER SIDE OF CUTTER)

G20 G10.9 X0

G91 G30 P3 X0.

G30 P3 Z0.

T3.00 T3 M06

G91 G30 P3 X0. Z0.

G90

M200

M212

G94 G0 G54 C109.9663

M108

G0 B59.7983

G97 S5000 M03

G0 G18 G43.4 X-.0025 Y-6.3811 Z1.8662

G1 X-.1321 Z1.7908 F20.

X-.1495 Y-6.3639 Z1.8108

X-.1769 Y-6.3555 Z1.8298

X-.2117 Y-6.3569 Z1.8456

X-.2506 Y-6.3678 Z1.8569

X-.2896 Y-6.3873 Z1.8626

X-.2619 Y-6.395 Z1.8676 C109.6915 B59.5816 F120.

X-.2067 Y-6.4112 Z1.8785 C109.1397 B59.1484

X-.1793 Y-6.4197 Z1.8844 C108.8634 B58.9314

X-.1521 Y-6.4284 Z1.8907 C108.5873 B58.7136

X-.125 Y-6.4371 Z1.8971 C108.3117 B58.4947

X-.098 Y-6.4455 Z1.9034 C108.0365 B58.2749

---

I also sent you an email with my contact information if you want to give a me call. I can cover a lot in a phone call that will take a while to type here.

 

Tom not on a Mazak if you have the eia parameters set-up correct it will read everything right off of the Mazatrol side of the machine. The suffix is what controls everything if you are using many tools. Not needed, but just a habit I have got into on our Integrex.

[crazy^millman]

I was wrong on his machine you do need the H. I talked to Craig and seems as though I was not much help. I think he may just have to fight with it till he figures out the right combination to get it working. Good luck Craig.

[IntegrexMan]

Still working on it and so is the Mazak guy...I just want to make it work before he does.

 

Ron...you are always a big help!!

[robk]

Also some more program samples on Integrex Machinist

[IntegrexMan]

Rob,

 

Not sure if they are the same ones that Crazy sent me, b/c I can't get to that site from work. If you get the chance, can you e-mail them to me?

Thanks,

Craig

[robk]

Check your mailbox Craig

[TOOLMAN]

Mazak Integrex 200 III SY

 

G128 E1

 

When performing simultaneous 5 axis op. Must also use G43.4 H"tool offset number" to calculate tool tip control. The G43.4 H# will be on the first G0 XYZ line in the program. Example: if T025125.0001 then G43.4 H25. Note the 125 tool offset number in the tool call. You must use a different tool offset number than is used in the "H" callout or it will compound your tool length each time the tool is called. I recommend adding 100 to the number 25 to get 125 to keep it simple. Cancel with G49.

 

Example:

 

N10

(CHAMFER TOP WIRE GROOVE)

G28 U0. Y0.

G28 W0.

M302

M200

T025125.0001 B20

G128 E1

G54

M250 M212

G0 B55.8512 C169.6669

M211

G97 S8127 M203

M248

G0 G18 X2.5284 Y.3137 Z-.8959 G43.4 H25

M8

G98 G1 X2.3628 Z-.952 F10.

.

. (PROGRAM REMOVED)

.

G0 X5.1137 Z.233

M9

G49

G28 U0. Y0. M205

G28 W0.

M01

 

Hope this helps.

 

Tim

[IntegrexMan]

Tim,

 

Thanks for the code...that is very similar to mine above except for the H offset. I tried that and my code still will not run??? Stange.

[DavidB]

Dont know if this helps but this is my code straight out of the In-house post.

 

code:

---

 N1

(T214 | 5. FLAT ENDMILL | LEN. - 0. | DIA. - 0. )

(TOOLPATH GROUP - TOOLPATH GROUP-1)

G21 G122.1

M901

M200

T214 M6 D000

G28 U0. V0. W0.

G97 S1527 M203

M248

G52.5 (MAZATROL COORDINATE SYSTEM CANCEL)

G10 L12 P[#51999] R[#[61000+#3020]/2] (TOOL RADIUS)

G10 L10 P[#51999] R#[60000+#3020] (TOOL LENGTH)

(WORK OFFSET G54 DATA SETTING)

G10 L2 P1 X#50700 (WORK OFFSET G54 X__)

G10 L2 P1 Y0.0 (WORK OFFSET G54 Y0.0)

#3200=3 (Z AXIS PARAMETER ROW OF S23)

#500=[#3223/100000] (#500 CAPTURES Z IN S23 PARAMETER)

G10 L2 P1 Z[#9101+[#500]] (WORK OFFSET G54 Z__)

G10 L2 P1 C#9102 (WORK OFFSET G54 C__)

G10 L2 P1 B0.0 (WORK OFFSET G54 B0.0)

G54

M250 M212

G98 G0 B90. C210.

M211

G0 X116.945 Z-87.97 G43.4 H0

Y0.

G98 G1 X21.945 F1000.

X16.945 F1.79

G93 X16.939 C204.4329 F92.76

X16.935 C198.8657 F92.79

C193.2985 F92.8

X16.938 C187.7313 F92.79

X16.94 C182.164 F92.77

X16.931 C176.5967 F92.79

X16.937 C171.0295 F92.8

X16.938 C165.4624 F92.79

X16.934 C159.8951 F92.79

X16.938 C154.3279 F92.79

X16.941 C148.7606 F92.77

X16.948 C143.1933 F92.75

X16.941 C137.6262 F92.75

X16.937 C132.0588 F92.77

X16.942 C126.4917 F92.77

X16.943 C120.9243 F92.76

X16.941 C115.3569 F92.76

X16.949 C109.7895 F92.74

X16.945 C105.6367 F124.31

G98 X21.945 F1000.

X66.945

G49

G69.5

G28 W0.

G28 U0. Y0.

---