Converting post from 9 to X

[mig]

Hi!

After converting post from v9 lost ability to get stock left value.

How to get this ability back?

Regards

[Guest]

mig,

 

Depends, how were you getting that out of V9?

[mig]

Hi John!

Glad to see you.

I converted post by c-hook according instructions .

Regards

[DavidB]

Are you talking about stock left in a surface toolpath as a note at the toolchange in the program?

[mig]

Yes DavidB.

[Guest]

mig,

 

Are you getting any errors on the output or simply not output at all?

[mig]

Hi,

This is part of post for ver 9 were taking stock value from:

pstock # Comment amount of stock to leave

spaces=0

if (opcode=13 | opcode=14),

[

pbld, n, pspc, "(TOOLPATH - ", *stoper, ")", e

pbld, n, pspc, "(STOCK LEFT ON DRIVE SURFS = ", *stock, ")", e

if check<>0, pbld, n, pspc, "(STOCK LEFT ON CHECK SURFS = ", *check, ")", e

]

spaces=0

if (opcode=2 | opcode=4),

[

pbld, n, pspc, "(TOOLPATH - ", *stoper, ")", e

pbld, n, pspc, "(STOCK LEFT ON X&Y = ", *stock2dxy, ")", e

pbld, n, pspc, "(STOCK LEFT ON Z = ", *stock2dz, ")", e

]

spaces=sav_spc

[Guest]

mig,

 

I Am looking at the same post I adjusted for you last week. Don't know if it is the same post that is giving you trouble but I noticed the stock variable is not defined.

 

I don't see either of these in that post

 

code:

---

fmt    2 stock      # Amount of Stock left on drive surfs

fmt 2 check # Amount of Stock left on check surfs

---

You have this

code:

---

fmt "DRIVE= "  2 surf_stock      # Amount of Stock left on drive surfs

fmt "CHECK= " 2 chek_stock # Amount of Stock left on check surfs

---

But you're not calling it at that point you're calling the original variables

[mig]

Hi John,

I not getting any errors, Just getting comment stock value =0,

Funniest that i converted this post 3 times on different computers and each time output is different.

[mig]

I have to take look , I at home now ,and my last post output at work.

[Jim Evans from CNC Software]

The stock value is probably coming from a parameter and some of these parameters have changed for X.

 

There is a document (Mastercam X post parameter reference.PDF) that shows all parameters changed for X it will show the mapping from V9 to X. You can get to this file through your start menu or by using explorer and looking in the mastercam Documentation folder.

 

Updatepost does NOT autmatically update these, so you must do so manually.

[Mgrenier]

Hello all,

 

I tried parameter 12437 for drive stock to leave and 10227 for check stock to leave but it still does not work.

 

Her is what I have in my post:

code:

---

fmt    2 stock      # Amount of Stock left on drive surfs

fmt 2 check # Amount of Stock left on check surfs

---

and

 

code:

---

fprmtbl 13      2         # Multisurf Finish

12437 stock # Amount of stock to leave on drive surfs

10227 check # Amount of stock to leave on check surfs

 

 

fprmtbl 14 2 # Multisurf Rough

12437 stock # Amount of stock to leave on drive surfs

10227 check # Amount of stock to leave on check surfs

---

and

 

code:

---

pstock     # Comment amount of stock to leave

spaces$=0

if (opcode$=13 | opcode$=14), pbld, n$," ", pspc, "(TOOLPATH - ", *stoper, ")", e$

if (opcode$=13 | opcode$=14), pbld, n$," ", pspc, "(STOCK LEFT ON DRIVE SURFS = ", *stock, ")", e$

#if (opcode=13 | opcode=14) & check<>0, pbld, n," ", pspc, "(STOCK LEFT ON CHECK SURFS = ", *check, ")", e

if (opcode$=13 | opcode$=14), pbld, n$," ", pspc, "(STOCK LEFT ON CHECK SURFS = ", *check, ")", e$

spaces$=sav_spc

---

And this still gives me 0. even if my values are set to .06 in MCAMX.

 

Also, I can't seem to find the parameter number for the op name to post out.

 

[ 09-15-2006, 10:06 AM: Message edited by: marting ]

[Jim Evans from CNC Software]

another thing to check is make sure that you have the "Write NC Operation Information" check box active in your control definition. This must be active for Mastercam to write the OPS information otherwise everythign is zero.

 

Do you have other parameters being used in this post?

You may need to post a code snippet of the postblock and postlines from PParameter or pwrttparam so I can see the logic that is making calls to the parameter look up tables.

[Mgrenier]

Thanks Jim,

 

I had to modify the control definition and everything worked out perfectly.

 

Have a good day,