Mpmaster post help again

[DavidB]

With the same tool I have a toolpath at B270 then another toolpath at B90.

I have a 400.mm retract at the end of the first toolpath so to clear the rotation of the B axis.

 

What the post outputs is the X,Y,Z and B move together on 1 line.

 

This will cause a crash and defeats the purpose of the 400.mm retract.

 

X2 Mpmaster code

code:

---

 G01 G40 X235.188 Y331.336

G00 Z20.

Z400.

(FINISH 3 LUGS DIAMETER 60.4MM)

M11 (UNLOCK)

X-301.042 Y329.83 Z20. B90.

M10 (LOCK)

Z7.89

G01 Z1. F850.

---

Same toolpaths posted with my V8 Mpmaster.

code:

---

 G01 G40 X235.188 Y331.336

G00 Z20.

Z400.

(FINISH 3 LUGS DIAMETER 60.4MM)

G00 M11 (UNLOCK)

B-270.

X-301.042 Y329.83

M10 (LOCK)

Z20.

---

B rotation first

X,Y Moves

Z move

 

Can I get this from the X2 Mpmaster?

I have "Break rapid moves-XY then Z for approach,Z then XY for retract Tick in my Control def?

 

 

Thanks

[Guest]

David rearrange the section that handles the out put like this

 

code:

---

if lock_codes = 1 & not(index) & rot_on_x, pbld, n$, *sunlock, "(UNLOCK)", e$

pbld, n$, pfcout, e$

pbld, n$, sgabsinc, [if not(index), pwcs], pfxout, pfyout, e$

if lock_codes = 1 & not(index) & rot_on_x & cuttype = 0, pbld, n$, *slock, "(LOCK)", e$

pbld, n$, pfzout, e$

---

[DavidB]

John

In the pindex section?

 

Thanks

[Guest]

Looking through quick it looks like the only place that complete output is handled is in the ptlchg0$

 

Looks like this section ptlchg_com could generate it as well

 

If another one shows up use debug and you should be able to track it down and make the same edits

[DavidB]

John,

I ran debug it's not at a toolchange, it's using the same tool at B90 retract then rotate to B270 for next toolpath.

 

quote:

---

G00 Z20. pzrapid$ prapidout

Z400. pzrapid$ prapidout

(FINISH 3 LUGS DIAMETER 60.4MM) pcomment$ pcomment2

M11 (UNLOCK) pcomment$ p__54:1715

X-301.042 Y329.83 Z20. B-270. pcomment$ p__54:1715

M10 (LOCK) pcomment$ p__54:1715

Z7.89 pzrapid$ prapidout

G01 Z1. F850. plin$ plinout

---

Thanks

[ToolMan184]

David,

 

Another thing you can do is open your old post up in editor and open the new post in the editor and compare the sections. Some things changed in the X2 posts but it will give you an idea of how to rearrange things. This is what I do sometimes and it works for me.

[DavidB]

Thanks ToolMan I've been doing just.

 

This is the last thing I need to nut out then I can use the new X2 Mpmaster for jobs.

 

My V8 post is good but I want to take advantage of the great new features in the X2 post.

 

Thanks

[monty]

I had simillar problem, I had to seperate XY, Z, and B(pfcout), in post.

 

Pl try this after Z rapid out in "ptlchg0"

 

pbld, n$, "G00",pfcout, e$

pbld, n$, pwcs, e$

pbld, n$, sgabsinc, pfxout, pfyout, e$

pbld, n$, pfzout, e$

 

and this is the output I am getting.

 

N720 G0 Z100.

N730 G00 Z1000.

(FACE 180 )

;DATUM PLANE X=268.998 Y=175.3 Z=206.266

N740 G00 B180.

N750 G15 H03

N760 X-25. Y-15.

N770 Z50.

N780 Z2.

N790 G1 Z0. F800.

[DavidB]

I think this be the area in ptlchg0?

 

code:

---

 pindex

if fmtrnd(prv_cabs) <> fmtrnd(cabs),

[

if lock_codes = one & not(index) & rot_on_x, pbld, n$, *sunlock, sunlockcomm, e$

pbld, n$, [if not(index), sgabsinc, pwcs], pfxout, pfyout, pfzout, pfcout, e$

---

Or am I way off?

[monty]

quote

-------------------------------------------------

 

pindex if fmtrnd(prv_cabs) <> fmtrnd(cabs),

[

if lock_codes = one & not(index) & rot_on_x, pbld, n$, *sunlock, sunlockcomm, e$ pbld, n$, [if not(index), sgabsinc, pwcs], pfxout, pfyout, pfzout, pfcout, e$

 

-----------------------------------------------

 

This seems to be the place where the output is coming from but only wierd thing is in your last message.

 

X-301.042 Y329.83 Z20. B-270. pcomment$ p__54:1715

 

I can't understand how can this be coming from pcomment.

[DavidB]

Monty,

 

I dont think it is coming from pindex as I added a force of my name and it did not post.

 

I agree I can not work out where it is coming from with debug.I'm no post guru.

 

Hopefully Brett from Inhouse will comment.

 

Thanks

[Guest]

Did you try the section I suggested?

 

Force your name out there.

 

[ 01-04-2007, 08:21 PM: Message edited by: John Paris @ CDES ]

[monty]

I did debug the output and everything is coming from ptlchg0 or ptlchg.

 

-------------------------------------------------

N690 X-21.15 Y36.633 I-42.3 J0. pcir$ pcirout 344.

N700 G1 X-23.65 Y40.963 plin$ plinout 346.

N710 Z-68. F999. plin$ plinout 348.

N720 G0 Z100. pzrapid$ prapidout 350.

N730 G00 Z1000. ptlchg0$ p__2:638 400.

(FACE 180 ) ptlchg0$ p__2:638 400.

;DATUM PLANE X=268.998 Y=175.3 Z=206.266 ptlchg0$ p__2:638 400.

N740 G00 B180. ptlchg0$ p__2:638 400.

N750 G15 H03 ptlchg0$ p__2:638 400.

N760 X-25. Y-15. ptlchg0$ p__2:638 400.

N770 Z50. ptlchg0$ p__2:638 400.

N780 Z2. pzrapid$ prapidout 402.

N790 G1 Z0. F800. plin$ plinout 404.

 

-------------------------------------------------

 

If you want I can send you comlete ptlchg0 and pindex code from my post for you to try.

[Greg Williams]

David,

 

Could come from here as well

 

ppos_cax_lin #Position the rotary axis before move - rapid

if index, pindex

else,

[

if fmtrnd(prv_cabs) <> fmtrnd(cabs) & rot_on_x,

[

sav_gcode = gcode$

gcode$ = zero

if mr10$>300, n$, "G0", *mr10$, e$

else, pbld, n$, "G0Z300.", e$

if prv_mi8$ = one, "G05P0(SGI OFF)", e$

pbld, n$, "M11 (UNLOCK)", e$

pbld, n$, sgcode, pcout, e$

pbld, n$, "M10 (LOCK)", e$

if mi8$ = one, "G05P10000(SGI ON)", e$

!cia

ps_cinc_calc

gcode$ = sav_gcode

!mi8$

]

]

 

 

Just out of interest what is wrong with the Old Post?

[DavidB]

I changed this in the ptlchg0 section

From this

code:

---

 if lock_codes = one & not(index) & rot_on_x, pbld, n$, *sunlock, sunlockcomm, e$

pbld, n$, [if not(index), sgabsinc, pwcs], pfxout, pfyout, pfzout, pfcout, e$

---

To this

code:

---

  if lock_codes = one & not(index) & rot_on_x, pbld, n$, *sunlock, sunlockcomm, e$

pbld, n$, [if not(index), sgabsinc, pwcs], pfcout,

---

This is the posted code now

code:

---

 G01 G40 X235.188 Y331.336

G00 Z20.

Z400.

(FINISH 3 LUGS DIAMETER 60.4MM)

M11 (UNLOCK)

B-270.

M10 (LOCK)

X-301.042 Y329.83 Z20.

Z7.89

G01 Z1. F850.

---

Now I just need to move the Z20. to a line below the X,Y move after M10 (lock)

 

Thanks

[DavidB]

Greg,

The new post uses the X style coolant options and has a lot more nice little things in it.

[Greg Williams]

David,

 

That could be a bad move as X Yand Z will not output at the Null tool change

 

Did you try the post from me

[Greg Williams]

quote:

---

The new post uses the X style coolant options and has a lot more nice little things in it.

---

I would add the new features to the old post if possible

[DavidB]

Greg,

Your post was for the 5-axis I have since updated all my 5-axis mahines to the Generic 5-axis post from X.

 

I want to update My V8 Mpmaster to the new X2 Mpamaster.

 

I check with the mode I made and I can not see it causeing a problem so far.

 

This is code I'm getting now.

code:

---

 G01 G40 X235.188 Y331.336                                   plin$ plinout

G00 Z20. pzrapid$ prapidout

Z400. pzrapid$ prapidout

(FINISH 3 LUGS DIAMETER 60.4MM) pcomment$ pcomment2

M11 (UNLOCK) pcomment$ p__54:1715

B90. pcomment$ p__54:1715

M10 (LOCK) pcomment$ p__54:1715

X-301.042 Y329.83 Z20. pcomment$ prapidout

Z7.89

---

How can I get the Z20. move from prapidout to the next line?

 

Thanks all

[Greg Williams]

David,

 

The post I copied that code from was old 4 Axis MPmaster set up for A77

 

Current Mpmaster has this

 

ppos_cax_lin #Position the rotary axis before move - rapid

if index, pindex

else,

[

if fmtrnd(prv_cabs) <> fmtrnd(cabs) & rot_on_x,

[

sav_gcode = gcode$

if convert_rpd$ = 1,

[

feed = maxfeedpm

gcode$ = 1

ipr_type = 0

]

else, gcode$ = zero

if lock_codes = one & not(index), pbld, n$, *sunlock, sunlockcomm, e$

pbld, n$, sgcode, pcout, e$

if lock_codes = one & not(index) & cuttype = 0, pbld, n$, *slock, slockcomm, e$

!cia

ps_cinc_calc

gcode$ = sav_gcode

]

]

 

 

Note that it calls Pindex

 

I still think your change will be a problem. It may become apparent when machining multiple ops with the same tool

[DavidB]

Greg the code below is multible ops with the same tool at 180 degree rotations.

The mod I made to pindex seems to have only now output the B move inbetween the clamping codes.

The following line after clamping I do not want the Z value.

 

code:

---

 G01 G40 X235.188 Y331.336                                   plin$ plinout

G00 Z20. pzrapid$ prapidout

Z400. pzrapid$ prapidout

(FINISH 3 LUGS DIAMETER 60.4MM) pcomment$ pcomment2

M11 (UNLOCK) pcomment$ p__54:1715

B90. pcomment$ p__54:1715

M10 (LOCK) pcomment$ p__54:1715

X-301.042 Y329.83 Z20. pcomment$ prapidout

Z7.89

---

What is the best way to get the Z20. move onto a sepperate line after the X,Y moves?

 

Thanks

 

[ 01-04-2007, 09:22 PM: Message edited by: DavidB ]

[gcode]

This isn't a post solution, but it will work

Use this Reference Points page to add a Z400.

approach point in the operation that generated the

index

then your output will be

(LOCK)

X-301.042 Y329.83 Z400.

[DavidB]

gcode yes you could do that.

Thanks

 

I use the Referance retract position to get the Z400. on the previous toolpath.

 

There are to many differances from the V8 to X2 post that a file compare does not work for me.As I said I'm no post guru.

 

I'd like to get the post working

Thanks

[Paul Decelles]

Just put a 400 clearance in the 2nd op to match the first op and you will get exactly what you are looking for. The post is outputting exactly what you are handing with the settings you currently have in your operations.

[DavidB]

Paul,

thanks for responding.

My V8 Mpmaster works without needing to have a Referance for the second toolpath.

 

Is there a way to get the Z axis move on a sepperate line after the rotaion?

 

I have been programming for years with a retract move only on the pre toolpath if I forget to put a clearance move on the following toolpath also this could be very dangerous.

 

Thanks