Need a Model or Center distance for a HAAs Trunnion.

[crazy^millman]

Everyone I need the center distance or a model of a TR310 5 axis trunnion for a HAAS. If you have this information please post up or email me.

[mayday]

Ron, It should be a nominal value. I cant remember what it is. 9" from the table rings a bell for me.

depends if you/they have the part set to an actual value for you to work with

[gcode]

Haas CNC

 

Ron this should have all the data you need

from the drawings , its looks like A and C have

a common C/L

[67 Yankee]

I don't know if the platter height is consistent from machine to machine but I can tell you what we have. Would be interesting to hear from other Haas trunnion users to see how much these number vary.

 

Our VF5 with the 210mm platter has the platter surface .1192" below the A axis centerline.

 

Our VF6 with the 310mm platter has the platter surface .1354" below the A axis center.

[ELS44]

The platter on the TR-310 should be -.125 from the A axis center line but this should be verified because they do vary.

[crazy^millman]

Thanks everyone for your responses. I just did everything for my customer incremental and once they figure out the center distance they can just move everything regen and they have their program.

[Guest CNC Apps Guy 1]

quote:

---

... I just did everything for my customer incremental...

---

UNLESS ABSOLUTELY POSITIVELY NECESSARY, this is EXACTLY how I do everything. So much easier if you need to move something around for some reason.

[Bruce Caulley]

quote:

---

quote:... I just did everything for my customer incremental...

 

UNLESS ABSOLUTELY POSITIVELY NECESSARY, this is EXACTLY how I do everything. So much easier if you need to move something around for some reason.

---

And a good reason why dynamic fixture comp should be a standard feature on all 5ax machines.

 

Bruce

[gcode]

If your your using a Generic Fanuc 5X based

post, its real easy.

Program everything at X0 Y0 Z0

In your post set shft_misc_r to 1

figure out the z offset and use

edit common parameters to write that value to

mr9

No need to shift geometry or regen..

[Guest CNC Apps Guy 1]

quote:

---

...And a good reason why dynamic fixture comp should be a standard feature on all 5ax machines.

---

Or use CAMplete

[Greg Williams]

quote:

---

Or use CAMplete

---

What machines do they support?

 

Personally I am a Vericut man but each to there own

 

[ 08-24-2009, 12:42 AM: Message edited by: Greg Williams ]

[John Summers]

How about a fixture with a pin parallel to the trunnion axis? It should tram the same at A=90 as it does at A=0.

[X-L Engineering Corp]

Gcode,

Were can I find that, I have 2 Tilt Rotary’s that are different sizes so they have different centerlines I have a 5 Axis Post I purchased thru In-House.

It would be great to be able to program the way you said and then just input the number according to the Machine I'm going to run it in.

 

TIA

 

Ted

[gcode]

In-House doesn't have that feature..

There is another way though.

Draw a point a X0 Y0 Z0

Make a copy of Top Plane.. Label in Main WCS

From the View Manger/Main WCS page click on that point to assign the origin of Main WCS.

This will make Main WCS associative to that point.

Create your program using Main WCS ..

just like you'd normally use Top as WCS

Once you know where the center of rotation is,

move that point to the correct location.

The whole file will go dirty. Regen and your done.

 

You could take this one step further..

Make 2 copies of Top and 2 points.. one for each

of your index tables.

Using "edit common parameters/planes" you can

change all your operations from one index table to the other by swapping out the WCS.

 

That way one file can support both index tables.

I do this at my current job..

 

We've got 5 different horizonatal boring mills

with rotaty tables standing on the B axis

Every one on them has a different center of rotation. One is even off center in 2 axis.

Using this method I can support all 5 machines with one MCX file.

[X-L Engineering Corp]

Thanks for the help I'll give it a try.

[Joeyls319]

Ron

I have this trunnion modeled up in mastercam if you would like it. I modeled it up for we I was creating the machine for our Vericut software.

 

Joey

[kunfuzed]

This is all greek to me! I need to find a five axis shop to work in!

[Don S at Barefoot CNC South]

Ron you have mail.

[Guest CNC Apps Guy 1]

Vericut does not do what CAMplete does. CAMplete is a Post Processor, but it also does gcode simulation, collision detection, and now it simulates material removal as well. NOt as clean as Vericut on the material removal but it's a new feature and it's coming along nicely.

 

CAMplete supports Matsuura MAM72 Series machines, Matsuura H.Plus series HMC's, Fanuc Robodrills with 5-Ax rotary tables, and I believe Mikrons as well.

[[email protected]]

Joeyls319

You have mail

[Ron Branch @ Verisurf]

don got your mail thanks, Joeyls I like seeing others people work if you do not mind sharing. I was able to help them get it going and it is working very nicely.

 

Big reason why I like the forum so much is people's willingness to share.

 

[Joeyls319]

Ron, Keith

 

You got mail.

 

Joey