how to change backplot to the way haas mill runs

[swanny]

back plot show rapid a direct movement in x,y,z and the haas will move at a 45 degree in both axis until it runs out of length in one axis and the finises off its rapid movement in the other axis. any way to backplot like this in mastercam or a setting to change in haas to run like backplot shows?

[Jmick]

parameter#315 will do this but Haas doesn't recomend doing it.

[MACHINEMASTERG]

parameter 315 and then witch bit to change???i just looked and dont see anything that says that. Ive never heard of this that you can change a haas from a dog leg move to a straight line move ??? please advise

[Mic6]

"Rapid->HS Feed"

[Leigh @ Kodiak]

Parameter 315. Turn the "Rapid -> HS feed" from 0 to 1

 

Haas doesn't just not recommend it, they will flat out tell you that it can't be done. I've used it her a couple times, but the drawback is that it causes canned cycles to no longer work

[Millertime]

--------------------------------------------------------------------------------

back plot show rapid a direct movement in x,y,z and the haas will move at a 45 degree in both axis until it runs out of length in one axis and the finises off its rapid movement in the other axis. any way to backplot like this in mastercam or a setting to change in haas to run like backplot shows?

 

Swizzo the best way to prevent this is to make sure youre rapid moves are above the part that way you dont crash and hit me up for another cutter.Seems to me this shop doasnt just need liability insurance but collision as well 180 and ur out again!!!!!!!!!!

[Millertime]

oh ya and i need a job# for that cutter since the one I gave you is now apart of part shape.

[MACHINEMASTERG]

thanks for tha 315 tip ....only available on newer controls the older ones dont have it ...thanks again

[Verndog]

Why not just clear Z axis out first to a safe spot then XY in seperate next line. This is easily done in the post.

[Leigh @ Kodiak]

quote:

---

Why not just clear Z axis out first to a safe spot then XY in seperate next line.

---

Obviously thats the easy way to avoid any dog-leg problems, but sometimes keeping the tool down will give massive time savings.

[Mark H]

In the Surface highspeed toolpaths you can use feed moves instead of rapid moves. With the feed moves, you get true point to point which will verify correctly. Also you can set those feed moves as fast as you want.

 

For example in the surface highspeed toolpaths go to the Linking Parameter page and select either Minimum Vertical Retract or Minimum Distance and then click the Output feed move check box and fill in the feedrate you want.

[John Morris]

Can anyone tell me if X5 machine simulation will show the Haas dogleg move at rapid? I have not set up machine simulation yet.

[André Lapointe@In-House Soluti]

Hi John,

the machine simulation won't show you the dogleg move. It will show something similar to the backplot in terms of rapid move.

[bogusmill]

In the Surface highspeed toolpaths you can use feed moves instead of rapid moves. With the feed moves, you get true point to point which will verify correctly. Also you can set those feed moves as fast as you want.

 

For example in the surface highspeed toolpaths go to the Linking Parameter page and select either Minimum Vertical Retract or Minimum Distance and then click the Output feed move check box and fill in the feedrate you want.

 

Everything seems to have a price, can you live with what this cost? In this case you have no rapid movements which renders the 5%, 25%, & 50% overide buttons useless. I tried this but found it to be worse than doglegs. Your results may vary, just be sure to tell your CNC operator they don't work before he highfeeds into big block of Ti64.