Numbered questions for mastercam

[medaq]

In the post towards the end

I am trying to turn off 164. But the post still posts out the lock codes and a rotation. Is there somewhere else that has these fields I need to adjust. I did look around the machine definition but I am not finding it. If this is the right spot to just edit the post and save. I can not figure out why it is still posting a axis rotation. 

 

# --------------------------------------------------------------------------
# Numbered questions for Mastercam

# --------------------------------------------------------------------------
38. Rapid feedrate? 300.0
1538. Rapid feedrate (metric)? 10000.0
#76. Configuration file name? 
80. Communications port number for receive and transmit (1 or 2) ? 2
81. Data rate (110,150,300,600,1200,2400,4800,9600,14400,19200,38400)? 9600
82. Parity (E/O/N)? E
83. Data bits (7 or 8)? 7
84. Stop bits (1 or 2)? 2
85. Strip line feeds? N
86. Delay after end of line (seconds)? 0
87. Ascii, Eia, or Binary (A/E/B)? A
88. Echo keyboard to screen in terminal emulation? n
89. Strip carriage returns? N
90. Drive and subdirectory for NC files?
91. Name of executable post processor? MP
92. Name of reverse post processor? RP
93. Reverse post PST file name? RPFAN
100. Number of places BEFORE the decimal point for sequence numbers? 0
101. Number of places AFTER the decimal point for sequence numbers? 0
103. Maximum spindle speed? 10000
107. Average time for tool change (seconds)? 2.0
159. Show first and last position as fully compensated in simulation? n
161. Enable Home Position button? y
162. Enable Reference Point button? y
163. Enable Misc. Values button? y
164. Enable Rotary Axis button? n
165. Enable Tool Plane button? y
166. Enable Construction Plane button? y
167. Enable Tool Display button? y
168. Check tplane during automatic work origin creation? y

[Guest]

This is really going to depend...

?164 wasn't even used anymore I thought...

How old is your post?

[medaq]

13 minutes ago, JParis said:

This is really going to depend...

?164 wasn't even used anymore I thought...

How old is your post?

 

 

Thought it would be newer. When we got 2017 I downloaded the mpmaster for 2017. This post was updated to 2018 by mastercam update utility. But here is the header.

 

[POST_VERSION] #DO NOT MOVE OR ALTER THIS LINE# V20.00 P0 E1 W20.00 T1496459933 M20.00 I0 O1
# Post Name           : MPMASTER
# Product             : MILL
# Machine Name        : MACHINE
# Control Name        : CONTROL
# Description         : IHS MASTER GENERIC MILL G-CODE POST
# 4-axis/Axis subs.   : YES
# 5-axis              : NO
# Subprograms         : YES
# Executable          : MP v11.0
# Post Revision       : 11.2.07337 (MC_FULL.MC_MINOR.YYDDD)

 

 

[crazy^millman]

If not using a 4th Axis then go into the MMD and delete that Axis.

[nickbe10]

I had this problem too. Couple of things to state first I am on X9 and my post (MPMaster) was actually first developed in X and I have kept it with me and modified and updated it thru the years. I tried deleting the A axis in the MD but still got A0 output. In the end I commented out all the post blocks which generate the rotations and this gave me all the other functionality I had added but without the A output.

Don't know if this is "the accepted way"  but it worked for me and I have had several years of trouble free posting on the three axis machines, at the same time the posts are basically intact which makes post modifications easier (if it's something I want in all the 3 and 4 axis posts) as all the line numbers in the post are maintained.

You can get rid of the lock codes by altering the header variable preset for lock codes. That's handy for machines that don't need them.

[So not a Guru]

On 6/7/2017 at 1:12 PM, C^Millman said:

If not using a 4th Axis then go into the MMD and delete that Axis

I think it is a better idea to create a new axis combo in the MD

[Colin Gilchrist]

42 minutes ago, So not a Guru said:

I think it is a better idea to create a new axis combo in the MD

This is true, only if you want to be able to switch back and forth between 3X or 4X output. If you always want "3X" only, and are modifying your post to only be a 3X Post, then just delete the Rotary Component, and make sure the Axis Combination is properly configured. (Mill Machine Table is checked...)