Tool call macro on Okuma

[Mic]

We've a Okuma MA-600HB with the OSP200 controller.

 

Operator is complaning over TxxM6 alarms if Txx is already in the spindle.

 

I'm quite sure I read about a soultion for this some years ago in here but now I can't find the thread.

 

Can anyone guide me in the right direction?

 

Thanks in advance.

[Allan]

Change up your tool call to check what tool is in the spindle, if it is the same one as the M6 line skip it like this:

 

IF [VTLCN EQ 1] N11

N1 T1 M06 ( 1/2 FLAT ENDMILL)

N11

 

OR

 

IF [VATOL EQ 19] N191

N19 T19 M06 (MILTEC FREEDOM 3")

N191

 

 

HTH

[Greg Williams]

OR

 

http://www.emastercam.com/board/index.php?showtopic=24828&hl=g116

[chris m]

IF [VATOL EQ 19] N191

T19 M06 (MILTEC FREEDOM 3")

N191

 

This is what we use; I wrote it into our post years ago

 

Greg, still like yours but haven't made the effort to change

[Mic]

Thank you guys :-)

[YoDoug®]

Here is one version I use

 

 

OATC1

(TOOL CHANGE MACRO)

(COMMAND IS G116 T?? Q??)

(T=DESIRED TOOL #, Q=NEXT TOOL #)

(G116 T0 WILL CLEAR TOOL FROM SPINDLE)

(FEB 5, 2004)

M329

M5

G0Z5000

IF[PT EQ 0]NMT

IF[VTLCN EQ PT] NFIN

IF[VNTOL EQ PT] NCH

IF[VNTOL EQ 0] NCHG

M64

NCHG T=PT M6

NFIN IF[VNTOL EQ 0] NTL

IF[VNTOL NE PQ] NCLR

GOTO NEND

NCH M6

GOTO NFIN

NCLR M64

NTL T=PQ

GOTO NEND

NMT IF[VNTOL EQ 0]NRID

M64

NRID M63

M6

NEND RTS

[mig]

What about using Ethernet connection? It not allow any logical branches in code .

[Greg Williams]

Or just change your post to this, If you use DNC-B it will not work. DNC-DT runs fine

 

 

spaces$=0

pbld, n$, "IF [VTLCN EQ ", *t$,"] ", *n$, " (SPINDLE TOOL CHECK)", e$

spaces$=sav_spc

n$ = n$ - seqinc$

pbld, n$, "T", *t$, ptoolcomm, e$

pbld, n$, "M6", e$

t_nt = t$

pbld, *n$, "(SPINDLE TOOL JUMP)", e$

[mig]

Can i check on conntrol what type of DNC we using ?

[Greg Williams]

DNC-B is drip feed

DNC-DT is ethernet

[mig]

Thank you.

[T_MALENA]

Doug, I sent you a message.