code to post editing?

[Sandybar]

I did a search for this, could not find what I'm looking for and I'm pretty sure I have seen this before.

 

When you are posting code is there an editor and or switch that puts in the post variable associated with that line?

 

I must be dreamming but I thought it was real.

[ToolMan184]

What version you using?

[Guest]

If you are in X, control deff >> nc output >> click on the debug box and repost, it will show you the post block

[Sandybar]

Version X2?

[Storkman]

What John said then.

[Sandybar]

Do you have to be in any specific editor?

[ToolMan184]

any text editor will work to mod the post

[Colin Gilchrist]

Sandybar,

 

The change to force the post to output the variable names is in the Control Definition file, not the text editor.

 

You should also use your text editor to edit the .PST file. Look for the "Debugging and program switches" section.

 

Here is a copy from one of my posts:

code:

---

 

# --------------------------------------------------------------------------

# Debugging and program switches

# --------------------------------------------------------------------------

fastmode$ : 1 #Posting speed optimizition

bug1$ : 2 #0=No display, 1=Generic list box, 2=Editor

bug2$ : 30 #Append postline labels, non-zero is column position? <---- This line forces the output of variables when debugging is enabled in the control definition file.

Set this value to a negative number (-40) to force the output of all variables associated with this output line.

bug3$ : 0 #Append whatline no. to each NC line?

bug4$ : 1 #Append NCI line no. to each NC line?

 

---

[Threept82]

Hi. I cant get the debug to work for nothin....

It is always posting with just the code.

[Colin Gilchrist]

Threept82,

 

If you make the change in the PST file and it still won't output the variable information, then the Control Definition is overriding the setting. Go to:

Machine Definition Manager - Edit Control Definition - NC Output page, and turn on the check box for "Enable post debugging" in the upper right corner.

 

HTH,

[monty]

Threept82

After editing control defination as collin said, Sometimes you need to open Machine defination manager again, pick control again in there and save the changes and post again it should work.

[J Coulston]

I find it faster to turn fastmode on and off in the post. Every time I go in to MD I have to reset the path to the directory I was working in PIMA.

 

pprep$

 

fastmode$ = 1

 

http://www.emastercam.com/cgi-bin/ultimate...t=020050#000005

[Colin Gilchrist]

John,

 

That only works if you have a V9 post that has been updated. If your post reads the MD/CD settings, these settings override the post file. That is what is happening to Sandybar. That post is set to read the CD and it won't output the postblock info. You have to go into the Machine Def manager, open the control def, and check or uncheck the "enable post debug" switch. This is true of any native X or X2 post that is provided by CNC Software (I'm not sure about MPMaster).

 

HTH,

[monty]

I have most of posts updated from mc9, Still control defination overrides post setting for debugging in all of them.

[monty]

Hi colin what is "HTH"

[?Mark]

hope

this

helps

[J Coulston]

Colin,

 

I am using the latest MPMaster post.

 

code:

---

 pprep$          #Pre-process postblock - Allows post instructions after the post is parsed but before the NC and NCI file are opened.

#DO NOT ATTEMPT TO OUTPUT TO THE NC FILE IN THIS POSTBLOCK (OR ANY POSTBLOCKS YOU MAY CALL FROM HERE) BECAUSE THE NC OUTPUT FILE IS NOT YET OPENED!

rd_mch_ent_no$ = 0 #Read only the machine base parameters (use to collect common parameters from CNC_MACHINE_TYPE)

rd_md$ #Read machine definition parameters

fastmode$ = 1

---

From the thread I mention earlier

Per Paul Decelles

quote:

---

You can also cheat (like I do) and add this to the top of your post (under the first line):

 

pprep$

fastmode$ = no$

 

 

(Do a search for pprep$ first and just add the fastmode$ = no$ in it if it exists)

 

Then you can just comment out the fastmode$ line to turn it off (or delete the two lines altogether when done "tweaking" the post).

---

Pauls advice didn't seem to be MPMaster specific so I assume it would work for any post.

[Threept82]

I miss Ver 9.

[Guest CNC Apps Guy 1]

quote:

---

...I miss Ver 9...

---

[Threept82]

A lot.